Represents the set of NXOpen.Assemblies.Component s that make up an assembly. More...

Inheritance diagram for NXOpen.Assemblies.ComponentAssembly:

Public Types
enum	SubstitutionMode { NonAssociative, SingleComponent, All }
	Defines how a component substitution operation is performed. More...

enum	OpenOption { ComponentOnly, ImmediateChildren, WholeAssembly, ReapplyRevRule }
	Open options for open_components More...

enum	OpenComponentStatus { SuccessfullyOpened, DeletedByOpen, CouldNotOpen }
	Open Component Status More...

enum	CheckinCheckoutOption { DesignElement, SourceItem, Both, Default }
	Check in and Check out options for components More...

enum	CloseModified { False, True }
	Indicates how close component should handle component parts when they are modified More...

enum	SuppressedState { Inherit, Suppressed, Unsuppressed, SuppressedByExp, UnsuppressedByExp }
	Defines the component supression states. More...

enum	OrderTargetLocation { PlaceBefore, PlaceAfter }
	Option controls whether reordered NXOpen.Assemblies.Component s are placed before or after the target NXOpen.Assemblies.Component More...

Public Types inherited from NXOpen.NXObject
enum	AttributeType { Invalid, Null, Boolean, Integer, Real, String, Time, Reference, Any = 100 }
	Specifies attribute type. More...

enum	DateAndTimeFormat { Numeric, Textual }
	Specifies the format of the date and time attribute. More...

Public Member Functions
unsafe NXOpen.Assemblies.Component	AddComponent (string partToAdd, string referenceSetName, string componentName, NXOpen.Point3d basePoint, NXOpen.Matrix3x3 orientation, int layer, out NXOpen.PartLoadStatus loadStatus)
	Creates a new NXOpen.Assemblies.Component in this assembly, based on an existing part file. More...

unsafe NXOpen.Assemblies.Component	AddComponent (string partToAdd, string referenceSetName, string componentName, NXOpen.Point3d basePoint, NXOpen.Matrix3x3 orientation, int layer, out NXOpen.PartLoadStatus loadStatus, bool uomAsNgc)
	Creates a new NXOpen.Assemblies.Component in this assembly, based on an existing part file. More...

unsafe void	AddComponents (NXOpen.Part[] partsToAdd, NXOpen.Point3d point, NXOpen.Matrix3x3 orientation, int layer, string referenceSetName, int count, bool scatter, out NXOpen.Assemblies.Component[] components)
	Creates new NXOpen.Assemblies.Component in this assembly, based on existing part files. More...

unsafe NXOpen.Assemblies.Component	AddComponent (NXOpen.BasePart partToAdd, string referenceSetName, string componentName, NXOpen.Point3d basePoint, NXOpen.Matrix3x3 orientation, int layer, out NXOpen.PartLoadStatus loadStatus)
	Creates a new NXOpen.Assemblies.Component in this assembly, based on an existing part file. More...

unsafe NXOpen.Assemblies.Component	AddMasterPartComponent (string partToAdd, string referenceSetName, string componentName, NXOpen.Point3d basePoint, NXOpen.Matrix3x3 orientation, int layer, out NXOpen.PartLoadStatus loadStatus)
	Creates a new NXOpen.Assemblies.Component in this assembly as master part. More...

unsafe NXOpen.Assemblies.Component	AddMasterPartComponent (NXOpen.Part partToAdd, string referenceSetName, string componentName, NXOpen.Point3d basePoint, NXOpen.Matrix3x3 orientation, int layer, out NXOpen.PartLoadStatus loadStatus)
	Creates a new NXOpen.Assemblies.Component in this assembly as master part. More...

unsafe NXOpen.Assemblies.Component	InsertProduct (NXOpen.Part productPart, int layer, out NXOpen.PartLoadStatus loadStatus)
	Adds a product into workset part at identity location. More...

unsafe NXOpen.Assemblies.Component	SubstituteComponent (NXOpen.Assemblies.Component component, NXOpen.BasePart part, string newName, string referenceSet, int layer, NXOpen.Assemblies.ComponentAssembly.SubstitutionMode mode)
	Substitutes an old component with a new component. More...

unsafe void	RemoveComponent (NXOpen.Assemblies.Component component)
	Removes a component from this assemebly. More...

unsafe NXOpen.Assemblies.Component	MapComponentFromParent (NXOpen.Assemblies.Component component)
	Maps a component in a parent assembly onto a corresponding component in this assembly. More...

unsafe NXOpen.Assemblies.Component[]	MapComponentsFromSubassembly (NXOpen.Assemblies.Component component)
	Maps a component in a subassembly onto the corresponding components in this parent assembly. More...

unsafe void	ChangeByName (string name, NXOpen.Assemblies.Component[] partOccs)
	Changes the current NXOpen.Assemblies.Arrangement of the given NXOpen.Assemblies.Component s to the NXOpen.Assemblies.Arrangement with the given name. More...

unsafe void	SetDefault (NXOpen.Assemblies.Arrangement arrangement)
	Set the default NXOpen.Assemblies.Arrangement for the given NXOpen.Assemblies.ComponentAssembly . More...

unsafe NXOpen.ErrorList	SuppressComponents (NXOpen.Assemblies.Component[] components, NXOpen.Assemblies.Arrangement[] arrangements)
	Suppresses an array of components More...

unsafe NXOpen.ErrorList	SuppressComponents (NXOpen.Assemblies.Component[] components)
	Suppresses an array of components in all NXOpen.Assemblies.Arrangement s in this ComponentAssembly More...

unsafe NXOpen.ErrorList	SuppressComponents (NXOpen.Assemblies.Component[] components, NXOpen.Assemblies.Arrangement[] arrangements, string expression)
	Suppresses an array of components in all NXOpen.Assemblies.Arrangement s in this ComponentAssembly More...

unsafe NXOpen.ErrorList	UnsuppressComponents (NXOpen.Assemblies.Component[] components, NXOpen.Assemblies.Arrangement[] arrangements)
	Unsuppresses an array of components in this ComponentAssembly More...

unsafe NXOpen.ErrorList	UnsuppressComponents (NXOpen.Assemblies.Component[] components)
	Unsuppresses an array of components in all NXOpen.Assemblies.Arrangement s in this ComponentAssembly More...

unsafe NXOpen.ErrorList	ReleaseSuppression (NXOpen.Assemblies.Component[] components, NXOpen.Assemblies.Arrangement[] arrangements)
	Release control of the suppression state of an array of components. More...

unsafe NXOpen.ErrorList	ReleaseSuppression (NXOpen.Assemblies.Component[] components)
	Release control of the suppression state of an array of components. More...

unsafe void	SetEntirePartRefset (NXOpen.Assemblies.Component component)
	Convenience method for setting the reference set used to represent a component to be the entire part. More...

unsafe void	SetEmptyRefset (NXOpen.Assemblies.Component component)
	Convenience method for setting the reference set used to represent a component to be empty More...

unsafe NXOpen.ErrorList	ReplaceReferenceSetInOwners (string newReferenceSet, NXOpen.Assemblies.Component[] components)
	Sets the reference set used to represent each component in an array. More...

unsafe void	ReplaceReferenceSet (NXOpen.Assemblies.Component component, string newReferenceSet)
	Replaces the reference set used by a component. More...

unsafe void	MoveComponent (NXOpen.Assemblies.Component component, NXOpen.Vector3d translation, NXOpen.Matrix3x3 rotation)
	Moves a component by specifying a translation and rotation. More...

unsafe NXOpen.Positioning.MatingConverter	CreateMatingConverter ()
	Creates a NXOpen.Positioning.MatingConverter object for this assembly. More...

unsafe void	DeleteMatingConditions ()
	Delete all the mating conditions in this assembly. More...

unsafe void	ConvertRememberedMcs ()
	Converts all remembered mating constraints in the part of this assembly to remembered assembly constraints More...

unsafe void	SetNonGeometricState (NXOpen.Assemblies.Component component, bool nonGeometricState)
	Sets the component state to Geometric or Non-Geometric. More...

unsafe bool	GetNonGeometricState (NXOpen.Assemblies.Component component)
	Gets the component state as Geometric or Non-Geometric. More...

unsafe NXOpen.Assemblies.ComponentQuantity	GetComponentQuantityType (NXOpen.Assemblies.Component component)
	Gets the quantity type of the components. More...

unsafe void	SetIntegerQuantity (NXOpen.Assemblies.Component component, int integerQuantity)
	Sets the integer quantity on this component. More...

unsafe int	GetIntegerQuantity (NXOpen.Assemblies.Component component)
	Gets the value of the integer quantity of component. More...

unsafe void	SetRealQuantity (NXOpen.Assemblies.Component component, double realQuantity, string quantityUnits)
	Sets the real quantity and corresponding units on this component. More...

unsafe double	GetRealQuantity (NXOpen.Assemblies.Component component, out string units)
	Gets the value of real quantity and corresponding units on this component. More...

unsafe void	SetAsRequiredQuantity (NXOpen.Assemblies.Component component)
	Sets the as-required quantity on this component. More...

unsafe string	GetAsRequiredQuantity (NXOpen.Assemblies.Component component)
	Gets the as-required quantity on this component. More...

unsafe NXOpen.Assemblies.Component[]	CopyComponents (NXOpen.Assemblies.Component[] components)
	Given an array of components, creates copies of the components such that each copy is created under the parent assembly of the original component. More...

unsafe void	RestructureComponents (NXOpen.Assemblies.Component[] origComponents, NXOpen.Assemblies.Component newParentComponent, bool deleteFlag, out NXOpen.Assemblies.Component[] newComponents, out NXOpen.ErrorList errorList)
	Given an array of components and a specified parent this function will transfer the given components to the parent. More...

unsafe NXOpen.PartLoadStatus	OpenComponents (NXOpen.Assemblies.ComponentAssembly.OpenOption openOption, NXOpen.Assemblies.Component[] componentsToOpen, out NXOpen.Assemblies.ComponentAssembly.OpenComponentStatus[] openStatus)
	Given an array of components, open the components using the open_option. More...

unsafe NXOpen.PartCloseStatus	CloseComponents (NXOpen.Assemblies.Component[] componentsToClose, NXOpen.BasePart.CloseWholeTree wholeTree, NXOpen.Assemblies.ComponentAssembly.CloseModified closeModified)
	Given an array of components, close the components. More...

unsafe NXOpen.Expression	GetSuppressionExpression (NXOpen.Assemblies.Component component)
	Gets the expression controlling the suppression of the component in its controlling arrangement More...

unsafe NXOpen.Expression	GetSuppressionExpression (NXOpen.Assemblies.Component component, NXOpen.Assemblies.Arrangement arrangement)
	Gets the expression controlling the suppression of the component in the given arrangment More...

unsafe NXOpen.Assemblies.ComponentAssembly.SuppressedState	GetSuppressedState (NXOpen.Assemblies.Component component, out bool controlled)
	Gets the suppression state of the component in its controlling arrangement More...

unsafe NXOpen.Assemblies.ComponentAssembly.SuppressedState	GetSuppressedState (NXOpen.Assemblies.Component component, NXOpen.Assemblies.Arrangement arrangement, out bool controlled)
	Gets the suppression state of the component in the given arrangement. More...

unsafe NXOpen.Assemblies.ComponentPatternBuilder	CreateComponentPatternBuilder (NXOpen.Assemblies.ComponentPattern compPattern)
	Creates a NXOpen.Assemblies.ComponentPatternBuilder object This can be used to create or edit a component pattern. More...

unsafe NXOpen.PartLoadStatus	AddPendingComponent (string partToAdd, NXOpen.NXObject pendingComponent, string referenceSetName, string componentName, NXOpen.Point3d basePoint, NXOpen.Matrix3x3 orientation, int layer, bool uomAsNgc)
	Add a pending NXOpen.Assemblies.Component in this assembly. More...

unsafe NXOpen.Positioning.ComponentConstraintGroupBuilder	CreateConstraintGroupBuilder (NXOpen.Positioning.ComponentConstraintGroup group, NXOpen.Assemblies.Component contextComponent)
	Creates a NXOpen.Positioning.ComponentConstraintGroupBuilder object. More...

unsafe NXOpen.ErrorList	CheckinComponents (NXOpen.Assemblies.Component[] partOccs, NXOpen.Assemblies.ComponentAssembly.CheckinCheckoutOption checkinInputOption)
	Checks in array of components as per the option NXOpen.Assemblies.ComponentAssembly.CheckinCheckoutOption . More...

unsafe NXOpen.ErrorList	CheckoutComponents (NXOpen.Assemblies.Component[] partOccs, NXOpen.Assemblies.ComponentAssembly.CheckinCheckoutOption checkoutInputOption)
	Checks out array of components as per the option NXOpen.Assemblies.ComponentAssembly.CheckinCheckoutOption . More...

unsafe NXOpen.ErrorList	CheckoutWorkset ()
	Checks out workset. More...

unsafe NXOpen.ErrorList	CheckinWorkset ()
	Checks in workset. More...

unsafe NXOpen.ErrorList	CheckoutAllModifiedObjects (out NXOpen.NXObject[] checkedOutObjects)
	Checks out all modified objects in the current session. More...

unsafe void	GetCheckedoutStatusOfObjects (out NXOpen.NXObject[] checkedOutObjects, out NXOpen.NXObject[] uncheckedOutObjects)
	Returns the checkedout status (checkedout/non checkedout) of all the objects open in NX. More...

unsafe void	ReorderComponents (NXOpen.Assemblies.ComponentOrder order, NXOpen.Assemblies.Component[] componentsToReorder, NXOpen.Assemblies.Component targetComponent, NXOpen.Assemblies.ComponentAssembly.OrderTargetLocation beforeOrAfter)
	Reorders the array of NXOpen.Assemblies.Component s before or after the target NXOpen.Assemblies.Component . More...

unsafe void	ReorderChildrenOfParent (NXOpen.Assemblies.ComponentOrder order, NXOpen.Assemblies.Component parentComponent, NXOpen.Assemblies.Component[] componentsToReorder)
	Assigns a new order to immediate children NXOpen.Assemblies.Component s of parent NXOpen.Assemblies.Component . More...

unsafe void	GetComponentOrders (out NXOpen.Assemblies.ComponentOrder[] orders)
	Returns all NXOpen.Assemblies.ComponentOrder s available in the part More...

unsafe void	MoveToPendingComponent (NXOpen.NXObject component)
	Move a NXOpen.Assemblies.Component in this assembly to a pending list. More...

unsafe NXOpen.Assemblies.Order	GetActiveOrder ()
	Returns the active order in the part More...

unsafe NXOpen.ErrorList	CreateIsolateViewWithComponents (NXOpen.Assemblies.Component[] components, out NXOpen.View view)
	Creates a temporary NXOpen.View and shows array of components in it and treats this as Isolate view till it gets undisplayed. More...

unsafe NXOpen.ErrorList	ShowComponentsInIsolateView (NXOpen.Assemblies.Component[] components, out NXOpen.View view)
	Shows array of components in Isolate view NXOpen.View . More...

unsafe NXOpen.ErrorList	HideComponentsInIsolateView (NXOpen.Assemblies.Component[] components, out NXOpen.View view)
	Hides array of components in Isolate view NXOpen.View . More...

Public Member Functions inherited from NXOpen.NXObject
unsafe void	SetUserAttribute (NXOpen.NXObject.AttributeInformation info, NXOpen.Update.Option option)
	Creates or modifies an attribute with the option to update or not. More...

unsafe void	SetUserAttribute (string title, int index, int value, NXOpen.Update.Option option)
	Creates or modifies an integer attribute with the option to update or not. More...

unsafe void	SetUserAttribute (string title, int index, double value, NXOpen.Update.Option option)
	Creates or modifies a real attribute with the option to update or not. More...

unsafe void	SetUserAttribute (string title, int index, string value, NXOpen.Update.Option option)
	Creates or modifies a string attribute with the option to update or not. More...

unsafe void	SetUserAttribute (string title, int index, NXOpen.Update.Option option)
	Creates or modifies a null attribute with the option to update or not. More...

unsafe void	SetTimeUserAttribute (string title, int index, string value, NXOpen.Update.Option option)
	Creates or modifies a time attribute with the option to update or not. More...

unsafe void	SetTimeUserAttribute (string title, int index, NXOpen.NXObject.ComputationalTime value, NXOpen.Update.Option option)
	Creates or modifies a time attribute with the option to update or not. More...

unsafe void	SetBooleanUserAttribute (string title, int index, bool value, NXOpen.Update.Option option)
	Creates or modifies a boolean attribute with the option to update or not. More...

unsafe NXOpen.AttributeIterator	CreateAttributeIterator ()
	Create an attribute iterator More...

unsafe bool	HasUserAttribute (NXOpen.AttributeIterator iterator)
	Determines if an attribute exists on the object, that satisfies the given iterator More...

unsafe bool	HasUserAttribute (string title, NXOpen.NXObject.AttributeType type, int index)
	Determines if an attribute with the given Title, Type and array Index is present on the object Unset attributes will not be detected by this function, as its purpose is to test for the actual presence of the attribute on the object. More...

unsafe int	GetUserAttributeCount (NXOpen.AttributeIterator iterator)
	Gets the count of set attributes on the object, if any, that satisfy the given iterator. More...

unsafe int	GetUserAttributeCount (NXOpen.AttributeIterator iterator, bool countArrayAsOneAttribute)
	Gets the count of set attributes on the object, if any, that satisfy the given iterator. More...

unsafe int	GetUserAttributeCount (NXOpen.NXObject.AttributeType type)
	Gets the count of set attributes on the object, if any, of the given type. More...

unsafe int	GetUserAttributeCount (NXOpen.NXObject.AttributeType type, bool includeUnset, bool countArrayAsOneAttribute)
	Gets the count of attributes on the object, if any, of the given type. More...

unsafe int	GetUserAttributeSize (string title, NXOpen.NXObject.AttributeType type)
	Gets the size of the first attribute encountered on the object, if any, with a given Title and Type. More...

unsafe bool	GetNextUserAttribute (NXOpen.AttributeIterator iterator, out NXOpen.NXObject.AttributeInformation info)
	Gets the next attribute encountered on the object, if any, that satisfies the given iterator. More...

unsafe NXOpen.NXObject.AttributeInformation	GetUserAttribute (string title, NXOpen.NXObject.AttributeType type, int index)
	Gets the first attribute encountered on the object, if any, with a given Title, Type and array Index. More...

unsafe bool	GetBooleanUserAttribute (string title, int index)
	Gets a boolean attribute by Title and array Index. More...

unsafe int	GetIntegerUserAttribute (string title, int index)
	Gets an integer attribute by Title and array Index. More...

unsafe double	GetRealUserAttribute (string title, int index)
	Gets a real attribute by Title and array Index. More...

unsafe string	GetStringUserAttribute (string title, int index)
	Gets a string attribute by Title and array Index. More...

unsafe string	GetTimeUserAttribute (string title, int index)
	Gets a time attribute by Title and array Index. More...

unsafe NXOpen.NXObject.ComputationalTime	GetComputationalTimeUserAttribute (string title, int index)
	Gets a time attribute by Title and array Index. More...

unsafe NXOpen.NXObject.AttributeInformation[]	GetUserAttributes (NXOpen.AttributeIterator iterator)
	Gets all the attributes that have been set on the given object, if any, that satisfy the given iterator. More...

unsafe NXOpen.NXObject.AttributeInformation[]	GetUserAttributes ()
	Gets all the attributes that have been set on the given object. More...

unsafe NXOpen.NXObject.AttributeInformation[]	GetUserAttributes (bool includeUnset)
	Gets all the attributes of the given object. More...

unsafe string	GetUserAttributeAsString (string title, NXOpen.NXObject.AttributeType type, int index)
	Gets the first attribute encountered on the object, if any, with a given title, type and array index. More...

unsafe void	DeleteUserAttributes (NXOpen.AttributeIterator iterator, NXOpen.Update.Option option)
	Deletes the attributes on the object, if any, that satisfy the given iterator More...

unsafe void	DeleteUserAttribute (NXOpen.NXObject.AttributeType type, string title, bool deleteEntireArray, NXOpen.Update.Option option)
	Deletes the first attribute encountered with the given Type, Title. More...

unsafe void	DeleteUserAttributes (NXOpen.NXObject.AttributeType type, NXOpen.Update.Option option)
	Deletes the attributes encountered with the given Type with option to update or not. More...

unsafe void	SetUserAttributeLock (string title, NXOpen.NXObject.AttributeType type, bool @lock)
	Lock or unlock the given attribute. More...

unsafe bool	GetUserAttributeLock (string title, NXOpen.NXObject.AttributeType type)
	Determine the lock of the given attribute. More...

unsafe NXOpen.NXObject[]	GetUserAttributeSourceObjects ()
	Returns an array of objects from which this object presents attributes. More...

unsafe void	SetPdmReferenceAttribute (string attributeTitle, string attributeValue)
	Sets the value of PDM Reference attribute on the object. More...

unsafe string	GetPdmReferenceAttributeValue (string attributeTitle)
	Gets the value of PDM Reference attribute for given object. More...

unsafe NXOpen.NXObject.AttributeInformation[]	GetUserAttribute (string title, bool includeUnset, bool addStringValues, NXOpen.NXObject.AttributeType type)
	Gets the first attribute (or attribute array) encountered on the object, if any, with a given Title and Type. More...

unsafe NXOpen.NXObject.AttributeInformation[]	GetUserAttributes (bool includeUnset, bool addStringValues)
	Gets all the attributes of the given object. More...

unsafe void	DeleteAllAttributesByType (NXOpen.NXObject.AttributeType type)
	Deletes all attributes of a specific type. More...

unsafe void	DeleteAllAttributesByType (NXOpen.NXObject.AttributeType type, NXOpen.Update.Option option)
	Deletes all attributes of a specific type with the option to update or not. More...

unsafe void	SetAttribute (string title, int value)
	Creates or modifies an integer attribute. More...

unsafe void	SetAttribute (string title, int value, NXOpen.Update.Option option)
	Creates or modifies an integer attribute with the option to update or not. More...

unsafe void	SetAttribute (string title, double value)
	Creates or modifies a real attribute. More...

unsafe void	SetAttribute (string title, double value, NXOpen.Update.Option option)
	Creates or modifies a real attribute with the option to update or not. More...

unsafe void	SetAttribute (string title, string value)
	Creates or modifies a string attribute. More...

unsafe void	SetAttribute (string title, string value, NXOpen.Update.Option option)
	Creates or modifies a string attribute with the option to update or not. More...

unsafe void	SetAttribute (string title)
	Creates or modifies a null attribute which is an attribute with a title and no value. More...

unsafe void	SetAttribute (string title, NXOpen.Update.Option option)
	Creates or modifies a null attribute with the option to update or not. More...

unsafe void	SetTimeAttribute (string title, string value)
	Creates or modifies a time attribute. More...

unsafe void	SetTimeAttribute (string title, string value, NXOpen.Update.Option option)
	Creates or modifies a time attribute with the option to update or not. More...

unsafe int	GetIntegerAttribute (string title)
	Gets an integer attribute by title. More...

unsafe double	GetRealAttribute (string title)
	Gets a real attribute by title. More...

unsafe string	GetStringAttribute (string title)
	Gets a string attribute value by title. More...

unsafe string	GetTimeAttribute (NXOpen.NXObject.DateAndTimeFormat format, string title)
	Gets a time attribute by title. More...

unsafe string	GetReferenceAttribute (string title)
	Gets the reference string (not the calculated value) of a string attribute that uses a reference string. More...

unsafe void	DeleteAttributeByTypeAndTitle (NXOpen.NXObject.AttributeType type, string title)
	Deletes an attribute by type and title. More...

unsafe void	DeleteAttributeByTypeAndTitle (NXOpen.NXObject.AttributeType type, string title, NXOpen.Update.Option option)
	Deletes an attribute by type and title with the option to update or not. More...

unsafe void	SetReferenceAttribute (string title, string value)
	Creates or modifies a string attribute which uses a reference string. More...

unsafe void	SetReferenceAttribute (string title, string value, NXOpen.Update.Option option)
	Creates or modifies a string attribute which uses a reference string, with the option to update or not. More...

unsafe NXOpen.NXObject.AttributeInformation[]	GetAttributeTitlesByType (NXOpen.NXObject.AttributeType type)
	Gets all the attribute titles of a specific type. More...

unsafe string[]	GetUserAttributesAsStrings ()
	Gets all the attributes that have been set on the given object. More...

unsafe NXOpen.INXObject	FindObject (string journalIdentifier)
	Finds the NXOpen.NXObject with the given identifier as recorded in a journal. More...

unsafe void	Print ()
	Prints a representation of this object to the system log file. More...

unsafe void	SetName (string name)
	Sets the custom name of the object. More...

Properties
NXOpen.Assemblies.ArrangementCollection	Arrangements `[get]`
	The collection of NXOpen.Assemblies.Arrangement s defined in the ComponentAssembly More...

NXOpen.Assemblies.ExplosionCollection	Explosions `[get]`
	The collection of NXOpen.Assemblies.Explosion s defined in the ComponentAssembly More...

NXOpen.Assemblies.DrawingExplosionCollection	DrawingExplosions `[get]`
	The collection of NXOpen.Assemblies.DrawingExplosion s defined in the ComponentAssembly More...

NXOpen.Assemblies.ComponentPatternCollection	ComponentPatterns `[get]`
	The collection of NXOpen.Assemblies.ComponentPattern defined in the ComponentAssembly More...

NXOpen.Assemblies.SubsetCollection	Subsets `[get]`
	The collection of NXOpen.Assemblies.Subset s defined in the ComponentAssembly More...

NXOpen.Assemblies.ClearanceSetCollection	ClearanceSets `[get]`
	The collection of NXOpen.Assemblies.ClearanceSet s defined in the ComponentAssembly More...

NXOpen.Assemblies.OrderCollection	OrdersSet `[get]`
	The collection of NXOpen.Assemblies.Order s defined in the ComponentAssembly More...

unsafe NXOpen.Assemblies.Arrangement	ActiveArrangement `[get, set]`
	Returns or sets the currently active NXOpen.Assemblies.Arrangement for this ComponentAssembly More...

unsafe NXOpen.Positioning.ComponentPositioner	Positioner `[get]`
	Returns the component positioner for this assembly. More...

unsafe NXOpen.Assemblies.Component	RootComponent `[get]`
	Returns the top-level component, i.e. More...

Properties inherited from NXOpen.NXObject
unsafe bool	IsOccurrence `[get]`
	Returns whether this object is an occurrence or not. More...

unsafe string	JournalIdentifier `[get]`
	Returns the identifier that would be recorded in a journal for this object. More...

unsafe string	Name `[get]`
	Returns the custom name of the object. More...

unsafe NXOpen.Assemblies.Component	OwningComponent `[get]`
	Returns the owning component, if this object is an occurrence. More...

unsafe NXOpen.BasePart	OwningPart `[get]`
	Returns the owning part of this object More...

unsafe NXOpen.INXObject	Prototype `[get]`
	Returns the prototype of this object if it is an occurrence. More...

Properties inherited from NXOpen.INXObject
bool	IsOccurrence `[get]`
	Returns whether this object is an occurrence or not. More...

string	JournalIdentifier `[get]`
	Returns the identifier that would be recorded in a journal for this object. More...

string	Name `[get]`
	Returns the custom name of the object. More...

NXOpen.Assemblies.Component	OwningComponent `[get]`
	Returns the owning component, if this object is an occurrence. More...

NXOpen.BasePart	OwningPart `[get]`
	Returns the owning part of this object More...

NXOpen.INXObject	Prototype `[get]`
	Returns the prototype of this object if it is an occurrence. More...

Detailed Description

Represents the set of NXOpen.Assemblies.Component s that make up an assembly.

Components are arranged in a tree structure, with a single component at the root. (See NXOpen.Assemblies.ComponentAssembly.RootComponent .) The components directly below the root are added to this assembly by calling NXOpen.Assemblies.ComponentAssembly.AddComponent . These "Top Level" components are said to be owned directly by this assembly. Top Level components may themselves have subcomponents.

Certain methods in this class will only operate on Top Level components. For example, NXOpen.Assemblies.ComponentAssembly.MoveComponent will throw an exception if the input component is not owned directly by this assembly.

Note, however, that input components will be mapped onto the correct component in the assembly. See NXOpen.Assemblies.ComponentAssembly.MapComponentFromParent .

For any methods that specify a component's position, the orientation matrix is in column order. The first column of the matrix specifies the X axis, the second the Y axis, and the third the Z axis.

To obtain an instance of this class, use NXOpen.BasePart.ComponentAssembly

Created in NX3.0.0

Member Enumeration Documentation

enum NXOpen.Assemblies.ComponentAssembly.CheckinCheckoutOption

Check in and Check out options for components

Enumerator
DesignElement	Checks in or Checks out the design element
SourceItem	Checks in or Checks out the source item that is referenced by a reuse design element or subordinate design element
Both	Checks in or Checks out the design element and its referenced source item
Default	Check In or Check Out option is determined by the system using whatever option is appropriate for the selected object type. For Reuse design element, the system defaults to checking out both the design element and the underlying item.

enum NXOpen.Assemblies.ComponentAssembly.CloseModified

Indicates how close component should handle component parts when they are modified

Enumerator
False	Close only unmodified parts, not modified parts
True	Close all parts, modified and unmodified

enum NXOpen.Assemblies.ComponentAssembly.OpenComponentStatus

Open Component Status

Enumerator
SuccessfullyOpened	The component was opened as expected
DeletedByOpen	The component was deleted on load as a result of the open
CouldNotOpen	The component could not be opened

enum NXOpen.Assemblies.ComponentAssembly.OpenOption

Open options for open_components

Enumerator
ComponentOnly	Open the component but none of its children
ImmediateChildren	Open the immediate children of an already open component
WholeAssembly	Open the component and all of its children
ReapplyRevRule	Reconfigure and open components based on current revision rules. If this option is used in native mode, it will behave just like Open Component.

enum NXOpen.Assemblies.ComponentAssembly.OrderTargetLocation

Option controls whether reordered NXOpen.Assemblies.Component s are placed before or after the target NXOpen.Assemblies.Component

Enumerator
PlaceBefore	Move reordered NXOpen.Assemblies.Component s before the target NXOpen.Assemblies.Component
PlaceAfter	Move reordered NXOpen.Assemblies.Component s after the target NXOpen.Assemblies.Component

enum NXOpen.Assemblies.ComponentAssembly.SubstitutionMode

Defines how a component substitution operation is performed.

Enumerator

NonAssociative

The old component is deleted, and the new one is added

SingleComponent

An associative substitution is performed.

As far as possible, this will attempt to preserve assembly constraints and interpart links.

All

An associative substitution is performed on all components that represent the same prototype part.

This effectively substitutes one child part for a new one.

enum NXOpen.Assemblies.ComponentAssembly.SuppressedState

Defines the component supression states.

Enumerator
Inherit	Inherit
Suppressed	Suppressed
Unsuppressed	Unsuppressed
SuppressedByExp	Suppressed by expression
UnsuppressedByExp	Unsuppressed by expression

Member Function Documentation

unsafe NXOpen.Assemblies.Component NXOpen.Assemblies.ComponentAssembly.AddComponent	(	string	partToAdd,
		string	referenceSetName,
		string	componentName,
		NXOpen.Point3d	basePoint,
		NXOpen.Matrix3x3	orientation,
		int	layer,
		out NXOpen.PartLoadStatus	loadStatus
	)

Creates a new NXOpen.Assemblies.Component in this assembly, based on an existing part file.

Created in NX3.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

partToAdd	The part that defines the new component
referenceSetName	The name of the reference set used to represent the new component
componentName	The name of the new component
basePoint	Location of the new component
orientation	Orientation matrix for the new component, in column order.
layer	The layer to place the new component on -1 means use the original layers defined in the component. 0 means use the work layer. 1-256 means use the specified layer.
loadStatus	Result of loading the part_to_add

Returns: The new Component

unsafe NXOpen.Assemblies.Component NXOpen.Assemblies.ComponentAssembly.AddComponent	(	string	partToAdd,
		string	referenceSetName,
		string	componentName,
		NXOpen.Point3d	basePoint,
		NXOpen.Matrix3x3	orientation,
		int	layer,
		out NXOpen.PartLoadStatus	loadStatus,
		bool	uomAsNgc
	)

Creates a new NXOpen.Assemblies.Component in this assembly, based on an existing part file.

Created in NX6.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

partToAdd	The part that defines the new component
referenceSetName	The name of the reference set used to represent the new component
componentName	The name of the new component
basePoint	Location of the new component
orientation	Orientation matrix for the new component, in column order.
layer	The layer to place the new component on -1 means use the original layers defined in the component. 0 means use the work layer. 1-256 means use the specified layer.
loadStatus	Result of loading the part_to_add

Returns: The new Component

Parameters

uomAsNgc Whether to set to non-geometric if with unit-of-measure

unsafe NXOpen.Assemblies.Component NXOpen.Assemblies.ComponentAssembly.AddComponent	(	NXOpen.BasePart	partToAdd,
		string	referenceSetName,
		string	componentName,
		NXOpen.Point3d	basePoint,
		NXOpen.Matrix3x3	orientation,
		int	layer,
		out NXOpen.PartLoadStatus	loadStatus
	)

Creates a new NXOpen.Assemblies.Component in this assembly, based on an existing part file.

Created in NX4.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

partToAdd	The part that defines the new component
referenceSetName	The name of the reference set used to represent the new component
componentName	The name of the new component
basePoint	Location of the new component
orientation	Orientation matrix for the new component, in column order.
layer	The layer to place the new component on -1 means use the original layers defined in the component. 0 means use the work layer. 1-256 means use the specified layer.
loadStatus	Result of loading the part_to_add

Returns: The new Component

unsafe void NXOpen.Assemblies.ComponentAssembly.AddComponents	(	NXOpen.Part[]	partsToAdd,
		NXOpen.Point3d	point,
		NXOpen.Matrix3x3	orientation,
		int	layer,
		string	referenceSetName,
		int	count,
		bool	scatter,
		out NXOpen.Assemblies.Component[]	components
	)

Creates new NXOpen.Assemblies.Component in this assembly, based on existing part files.

Created in NX12.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

partsToAdd	The parts that define new components
point	Location of the new component
orientation	Orientation matrix for the new component, in column order.
layer	The layer to place the new component on -1 means use the original layers defined in the component. 0 means use the work layer. 1-256 means use the specified layer.
referenceSetName	The name of the reference set used to represent the new component
count	number of times each part to be added as component in parent part
scatter	Scatter the multiple components around the specified location
components	The array of components added to the parent part

unsafe NXOpen.Assemblies.Component NXOpen.Assemblies.ComponentAssembly.AddMasterPartComponent	(	string	partToAdd,
		string	referenceSetName,
		string	componentName,
		NXOpen.Point3d	basePoint,
		NXOpen.Matrix3x3	orientation,
		int	layer,
		out NXOpen.PartLoadStatus	loadStatus
	)

Creates a new NXOpen.Assemblies.Component in this assembly as master part.

Created in NX3.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

partToAdd	The part that defines the new component
referenceSetName	The name of the reference set used to represent the new component
componentName	The name of the new component
basePoint	Location of the new component
orientation	Orientation matrix for the new component, in column order.
layer	The layer to place the new component on -1 means use the original layers defined in the component. 0 means use the work layer. 1-256 means use the specified layer.
loadStatus	Result of loading the part_to_add

Returns: The new Component

unsafe NXOpen.Assemblies.Component NXOpen.Assemblies.ComponentAssembly.AddMasterPartComponent	(	NXOpen.Part	partToAdd,
		string	referenceSetName,
		string	componentName,
		NXOpen.Point3d	basePoint,
		NXOpen.Matrix3x3	orientation,
		int	layer,
		out NXOpen.PartLoadStatus	loadStatus
	)

Creates a new NXOpen.Assemblies.Component in this assembly as master part.

Created in NX4.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

partToAdd	The part that defines the new component
referenceSetName	The name of the reference set used to represent the new component
componentName	The name of the new component
basePoint	Location of the new component
orientation	Orientation matrix for the new component, in column order.
layer	The layer to place the new component on -1 means use the original layers defined in the component. 0 means use the work layer. 1-256 means use the specified layer.
loadStatus	Result of loading the part_to_add

Returns: The new Component

unsafe NXOpen.PartLoadStatus NXOpen.Assemblies.ComponentAssembly.AddPendingComponent	(	string	partToAdd,
		NXOpen.NXObject	pendingComponent,
		string	referenceSetName,
		string	componentName,
		NXOpen.Point3d	basePoint,
		NXOpen.Matrix3x3	orientation,
		int	layer,
		bool	uomAsNgc
	)

Add a pending NXOpen.Assemblies.Component in this assembly.

Created in NX8.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

partToAdd	The part that defines the new component
pendingComponent	component to add
referenceSetName	The name of the reference set used to represent the new component
componentName	The name of the new component
basePoint	Location of the new component
orientation	Orientation matrix for the new component, in column order.
layer	The layer to place the new component on -1 means use the original layers defined in the component. 0 means use the work layer. 1-256 means use the specified layer.
uomAsNgc	Whether to set to non-geometric if with unit-of-measure

Returns: Result of loading the part_to_add

unsafe void NXOpen.Assemblies.ComponentAssembly.ChangeByName	(	string	name,
		NXOpen.Assemblies.Component[]	partOccs
	)

Changes the current NXOpen.Assemblies.Arrangement of the given NXOpen.Assemblies.Component s to the NXOpen.Assemblies.Arrangement with the given name.

Created in NX7.5.2

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

name	The name of arrangement to change to
partOccs	The NXOpen.Assemblies.Component s to be modified

unsafe NXOpen.ErrorList NXOpen.Assemblies.ComponentAssembly.CheckinComponents	(	NXOpen.Assemblies.Component[]	partOccs,
		NXOpen.Assemblies.ComponentAssembly.CheckinCheckoutOption	checkinInputOption
	)

Checks in array of components as per the option NXOpen.Assemblies.ComponentAssembly.CheckinCheckoutOption .

Created in NX8.5.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

partOccs	Array of components to check in
checkinInputOption	Option that controls what to check in

Returns: Any errors that occurred during the check in

unsafe NXOpen.ErrorList NXOpen.Assemblies.ComponentAssembly.CheckinWorkset ( )

Checks in workset.

Created in NX8.5.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Returns: Any errors that occurred during checking in of workset

unsafe NXOpen.ErrorList NXOpen.Assemblies.ComponentAssembly.CheckoutAllModifiedObjects ( out NXOpen.NXObject[] checkedOutObjects )

Checks out all modified objects in the current session.

checkedOutObjects collection will be type of NXOpen.BasePart or NXOpen.PDM.DesignElementRevision

Created in NX8.5.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

checkedOutObjects Array of NXObjects checked out

Returns: Any errors that occurred during checking out of objects

unsafe NXOpen.ErrorList NXOpen.Assemblies.ComponentAssembly.CheckoutComponents	(	NXOpen.Assemblies.Component[]	partOccs,
		NXOpen.Assemblies.ComponentAssembly.CheckinCheckoutOption	checkoutInputOption
	)

Checks out array of components as per the option NXOpen.Assemblies.ComponentAssembly.CheckinCheckoutOption .

Created in NX8.5.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

partOccs	Array of components to check out
checkoutInputOption	Option that controls what to check out

Returns: Any errors that occurred during the check out

unsafe NXOpen.ErrorList NXOpen.Assemblies.ComponentAssembly.CheckoutWorkset ( )

Checks out workset.

Created in NX8.5.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Returns: Any errors that occurred during checking out of workset

unsafe NXOpen.PartCloseStatus NXOpen.Assemblies.ComponentAssembly.CloseComponents	(	NXOpen.Assemblies.Component[]	componentsToClose,
		NXOpen.BasePart.CloseWholeTree	wholeTree,
		NXOpen.Assemblies.ComponentAssembly.CloseModified	closeModified
	)

Given an array of components, close the components.

This close of the components will check for different reasons that the part cannot be closed. The reasons will be returned in the PartCloseStatus object.

Created in NX6.0.1

License requirements: None.

Parameters

componentsToClose	Array of components to close
wholeTree	If true, unloads all components of the part. If false, unloads only the top-level part
closeModified	Behavior of close if component parts are modified.

Returns: Close status for the parts

unsafe void NXOpen.Assemblies.ComponentAssembly.ConvertRememberedMcs ( )

Converts all remembered mating constraints in the part of this assembly to remembered assembly constraints

Created in NX7.5.0

License requirements: assemblies ("ASSEMBLIES MODULE")

unsafe NXOpen.Assemblies.Component [] NXOpen.Assemblies.ComponentAssembly.CopyComponents ( NXOpen.Assemblies.Component[] components )

Given an array of components, creates copies of the components such that each copy is created under the parent assembly of the original component.

The original components do not need to be under the same parent assembly as each other.

The number of new components may be different from the original number of components if problems occurred during the copy.

Created in NX6.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

components Components to be copied.

Returns: The newly created copies.

unsafe NXOpen.Assemblies.ComponentPatternBuilder NXOpen.Assemblies.ComponentAssembly.CreateComponentPatternBuilder ( NXOpen.Assemblies.ComponentPattern compPattern )

Creates a NXOpen.Assemblies.ComponentPatternBuilder object This can be used to create or edit a component pattern.

Created in NX9.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

compPattern The pattern definition object will be used in edit

Returns

unsafe NXOpen.Positioning.ComponentConstraintGroupBuilder NXOpen.Assemblies.ComponentAssembly.CreateConstraintGroupBuilder	(	NXOpen.Positioning.ComponentConstraintGroup	group,
		NXOpen.Assemblies.Component	contextComponent
	)

Creates a NXOpen.Positioning.ComponentConstraintGroupBuilder object.

This can be used to create a constraint group or edit an existing constraint group. The context component decides which displayed constraints are to be used from the member constraints of an existing constraint group. If the context component is a null reference (Nothing in Visual Basic) the displayed constraints used are in the same part as the member constraints.

Created in NX8.0.1

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

group	Group to be edited, if a null reference (Nothing in Visual Basic) then a new group is created
contextComponent	Context component, can be a null reference (Nothing in Visual Basic)

Returns

unsafe NXOpen.ErrorList NXOpen.Assemblies.ComponentAssembly.CreateIsolateViewWithComponents	(	NXOpen.Assemblies.Component[]	components,
		out NXOpen.View	view
	)

Creates a temporary NXOpen.View and shows array of components in it and treats this as Isolate view till it gets undisplayed.

Only one Isolate view can be created for the assembly. Returns NXOpen.View which is treated as Isolate View.

Created in NX11.0.1

License requirements: gateway ("UG GATEWAY")

Parameters

components	Array of components to be shown in isolate view
view	Return the isolate view

Returns: list of errors encountered during components shown in isolate view

unsafe NXOpen.Positioning.MatingConverter NXOpen.Assemblies.ComponentAssembly.CreateMatingConverter ( )

Creates a NXOpen.Positioning.MatingConverter object for this assembly.

This can be used to convert Mating Conditions in this part and in its child components to Assembly Constraints. Note that this part need not be the work part for this.

Created in NX5.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Returns: The new Mating Converter

unsafe void NXOpen.Assemblies.ComponentAssembly.DeleteMatingConditions ( )

Delete all the mating conditions in this assembly.

This can be used before creating assembly constraints in the assembly, if the mating conditions are not being converted. Component-component mating conditions and inherited mating conditions are not deleted. Update should be called afterwards.

Created in NX7.5.0

License requirements: assemblies ("ASSEMBLIES MODULE")

unsafe NXOpen.Assemblies.Order NXOpen.Assemblies.ComponentAssembly.GetActiveOrder ( )

Returns the active order in the part

Created in NX10.0.3

License requirements: assemblies ("ASSEMBLIES MODULE")

Returns

unsafe string NXOpen.Assemblies.ComponentAssembly.GetAsRequiredQuantity ( NXOpen.Assemblies.Component component )

Gets the as-required quantity on this component.

Created in NX6.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

component The component to edit. Must be directly owned by this assembly.

Returns: As-Required string "A/R"

unsafe void NXOpen.Assemblies.ComponentAssembly.GetCheckedoutStatusOfObjects	(	out NXOpen.NXObject[]	checkedOutObjects,
		out NXOpen.NXObject[]	uncheckedOutObjects
	)

Returns the checkedout status (checkedout/non checkedout) of all the objects open in NX.

Created in NX8.5.0

License requirements: None.

Parameters

checkedOutObjects	Array of NXObjects which are open in session and checked out
uncheckedOutObjects	Array of NXObjects which are open in session but not checkout

unsafe void NXOpen.Assemblies.ComponentAssembly.GetComponentOrders ( out NXOpen.Assemblies.ComponentOrder[] orders )

Returns all NXOpen.Assemblies.ComponentOrder s available in the part

Created in NX9.0.0

License requirements: None.

Parameters

orders Returns array of NXOpen.Assemblies.ComponentOrder s in part

unsafe NXOpen.Assemblies.ComponentQuantity NXOpen.Assemblies.ComponentAssembly.GetComponentQuantityType ( NXOpen.Assemblies.Component component )

Gets the quantity type of the components.

Returns NXOpen.Assemblies.ComponentQuantity .

Created in NX6.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

component The component to query. Must be directly owned by this assembly.

Returns: Quantity type an enumeration value

unsafe int NXOpen.Assemblies.ComponentAssembly.GetIntegerQuantity ( NXOpen.Assemblies.Component component )

Gets the value of the integer quantity of component.

Created in NX6.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

component The component to query. Must be directly owned by this assembly.

Returns: Integer quantity value

unsafe bool NXOpen.Assemblies.ComponentAssembly.GetNonGeometricState ( NXOpen.Assemblies.Component component )

Gets the component state as Geometric or Non-Geometric.

Created in NX6.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

component The component to query. Must be directly owned by this assembly.

Returns: True if the component is non-geometric, false otherwise

unsafe double NXOpen.Assemblies.ComponentAssembly.GetRealQuantity	(	NXOpen.Assemblies.Component	component,
		out string	units
	)

Gets the value of real quantity and corresponding units on this component.

Created in NX6.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

component The component to query. Must be directly owned by this assembly.

Returns: Real quantity value

Parameters

units Units

unsafe NXOpen.Assemblies.ComponentAssembly.SuppressedState NXOpen.Assemblies.ComponentAssembly.GetSuppressedState	(	NXOpen.Assemblies.Component	component,
		out bool	controlled
	)

Gets the suppression state of the component in its controlling arrangement

Created in NX6.0.4

License requirements: None.

Parameters

component The component to query.

Returns: The suppressed state

Parameters

controlled Is the suppression state controlled at the level of arrangement?

unsafe NXOpen.Assemblies.ComponentAssembly.SuppressedState NXOpen.Assemblies.ComponentAssembly.GetSuppressedState	(	NXOpen.Assemblies.Component	component,
		NXOpen.Assemblies.Arrangement	arrangement,
		out bool	controlled
	)

Gets the suppression state of the component in the given arrangement.

Created in NX6.0.4

License requirements: None.

Parameters

component	The component to query.
arrangement	Arrangements in which components should be suppressed.

Returns: The suppressed state

Parameters

controlled Is the suppression state controlled at the level of arrangement?

unsafe NXOpen.Expression NXOpen.Assemblies.ComponentAssembly.GetSuppressionExpression ( NXOpen.Assemblies.Component component )

Gets the expression controlling the suppression of the component in its controlling arrangement

Created in NX6.0.4

License requirements: None.

Parameters

component The component to query.

Returns: The suppression expression.

unsafe NXOpen.Expression NXOpen.Assemblies.ComponentAssembly.GetSuppressionExpression	(	NXOpen.Assemblies.Component	component,
		NXOpen.Assemblies.Arrangement	arrangement
	)

Gets the expression controlling the suppression of the component in the given arrangment

Created in NX6.0.4

License requirements: None.

Parameters

component	The component to query.
arrangement	The arrangement in which to query the suppressed state

Returns: The suppression expression.

unsafe NXOpen.ErrorList NXOpen.Assemblies.ComponentAssembly.HideComponentsInIsolateView	(	NXOpen.Assemblies.Component[]	components,
		out NXOpen.View	view
	)

Hides array of components in Isolate view NXOpen.View .

If Isolate view doesn't exist then this API doesn't do anything. Returns NXOpen.View which is treated as Isolate View.

Created in NX11.0.1

License requirements: gateway ("UG GATEWAY")

Parameters

components	Array of components to be shown in isolate view
view	Return the isolate view

Returns: list of errors encountered during components shown in isolate view

unsafe NXOpen.Assemblies.Component NXOpen.Assemblies.ComponentAssembly.InsertProduct	(	NXOpen.Part	productPart,
		int	layer,
		out NXOpen.PartLoadStatus	loadStatus
	)

Adds a product into workset part at identity location.

Created in NX12.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

productPart	The product being added to the workset
layer	The layer to place the new component on -1 means use the original layers defined in the component. 0 means use the work layer. 1-256 means use the specified layer.
loadStatus	Result of loading the part_to_add

Returns: The new Component

unsafe NXOpen.Assemblies.Component NXOpen.Assemblies.ComponentAssembly.MapComponentFromParent ( NXOpen.Assemblies.Component component )

Maps a component in a parent assembly onto a corresponding component in this assembly.

For example, given an Axle assembly:

      Axle 
    /      \           
   /        \          
Left        Right      
Wheel       Wheel      

and a Car assembly containing two Axle components:

                      Car 
               _______ |_______                    
              /                \                   
             /                  \                  
        Front                     Rear             
        Axle                      Axle             
      /      \                  /      \           
     /        \                /        \          
Front Left  Front Right    Rear Left   Rear Right  
  Wheel       Wheel         Wheel       Wheel      

then calling Axle.MapComponentFromParent with the Front Left Wheel component will return the Left Wheel component. Note that calling Car.MapComponentFromParent on Left Wheel will not work. See NXOpen.Assemblies.ComponentAssembly.MapComponentsFromSubassembly .

Calling Axle.MapComponent with the Left Wheel component will simply return Left Wheel, i.e. it is a null operation.

Note that calling this method may load additional assembly data from the Axle part.

Created in NX3.0.0

License requirements: None.

Parameters

component The component to map. This should be defined in the tree of a parent assembly which contains this assembly.

Returns: The mapped component. This will be defined in the component tree of this assembly parameter.

unsafe NXOpen.Assemblies.Component [] NXOpen.Assemblies.ComponentAssembly.MapComponentsFromSubassembly ( NXOpen.Assemblies.Component component )

Maps a component in a subassembly onto the corresponding components in this parent assembly.

For example, given an Axle assembly:

      Axle 
    /      \           
   /        \          
Left        Right      
Wheel       Wheel      

and a Car assembly containing two Axle components:

                      Car 
               _______ |_______                    
              /                \                   
             /                  \                  
        Front                     Rear             
        Axle                      Axle             
      /      \                  /      \           
     /        \                /        \          
Front Left  Front Right    Rear Left   Rear Right  
  Wheel       Wheel         Wheel       Wheel      

then calling Car.MapComponentsFromSubassembly on Left Wheel will return Front Left Wheel and Rear Left Wheel. See also NXOpen.Assemblies.ComponentAssembly.MapComponentFromParent .

Created in NX3.0.0

License requirements: None.

Parameters

component The component to map. This must be defined in a subassembly of this assembly.

Returns: The mapped components.

unsafe void NXOpen.Assemblies.ComponentAssembly.MoveComponent	(	NXOpen.Assemblies.Component	component,
		NXOpen.Vector3d	translation,
		NXOpen.Matrix3x3	rotation
	)

Moves a component by specifying a translation and rotation.

Note that these are specified in the coordinates of this assembly, which are not necessarily the coordinates of the displayed part. Note that the rotation matrix is expected to be stored in a column order fashion.

Created in NX3.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

component	The component to edit. Must be directly owned by this assembly
translation	The translation delta
rotation	The rotation delta, in column order.

unsafe void NXOpen.Assemblies.ComponentAssembly.MoveToPendingComponent ( NXOpen.NXObject component )

Move a NXOpen.Assemblies.Component in this assembly to a pending list.

The NXOpen.Assemblies.Component should be previously in the pending list and just got added into the assembly.

Created in NX10.0.2

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

component component to move to pending list

unsafe NXOpen.PartLoadStatus NXOpen.Assemblies.ComponentAssembly.OpenComponents	(	NXOpen.Assemblies.ComponentAssembly.OpenOption	openOption,
		NXOpen.Assemblies.Component[]	componentsToOpen,
		out NXOpen.Assemblies.ComponentAssembly.OpenComponentStatus[]	openStatus
	)

Given an array of components, open the components using the open_option.

Created in NX6.0.1

License requirements: None.

Parameters

openOption	The option that controls the open operation
componentsToOpen	Array of components to open
openStatus	Shows the status of the objects in an indexed array according to if they could be opened

Returns: If any components could not be loaded, this object contains the error information.

unsafe NXOpen.ErrorList NXOpen.Assemblies.ComponentAssembly.ReleaseSuppression	(	NXOpen.Assemblies.Component[]	components,
		NXOpen.Assemblies.Arrangement[]	arrangements
	)

Release control of the suppression state of an array of components.

The components will no longer have their suppression state controlled by the given arrangements. (Note that it is not an error if the given arrangements do not control the components.)

Created in NX3.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

components	NXOpen.Assemblies.Component s to be released
arrangements	Arrangements in which components should be released. These arrangements must be defined in this ComponentAssembly

Returns: list of errors encountered during the release

unsafe NXOpen.ErrorList NXOpen.Assemblies.ComponentAssembly.ReleaseSuppression ( NXOpen.Assemblies.Component[] components )

Release control of the suppression state of an array of components.

The components will no longer have their suppression state controlled by any of the arrangements in the ComponentAssembly.

Created in NX3.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

components NXOpen.Assemblies.Component s to be released

Returns: list of errors encountered during the release

unsafe void NXOpen.Assemblies.ComponentAssembly.RemoveComponent ( NXOpen.Assemblies.Component component )

Removes a component from this assemebly.

Created in NX3.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

component The component to remove. Must be directly owned by this assembly.

unsafe void NXOpen.Assemblies.ComponentAssembly.ReorderChildrenOfParent	(	NXOpen.Assemblies.ComponentOrder	order,
		NXOpen.Assemblies.Component	parentComponent,
		NXOpen.Assemblies.Component[]	componentsToReorder
	)

Assigns a new order to immediate children NXOpen.Assemblies.Component s of parent NXOpen.Assemblies.Component .

Created in NX9.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

order	NXOpen.Assemblies.ComponentOrder in which children are reordered
parentComponent	Parent component whose children are reordered
componentsToReorder	Array of children components in new order

unsafe void NXOpen.Assemblies.ComponentAssembly.ReorderComponents	(	NXOpen.Assemblies.ComponentOrder	order,
		NXOpen.Assemblies.Component[]	componentsToReorder,
		NXOpen.Assemblies.Component	targetComponent,
		NXOpen.Assemblies.ComponentAssembly.OrderTargetLocation	beforeOrAfter
	)

Reorders the array of NXOpen.Assemblies.Component s before or after the target NXOpen.Assemblies.Component .

NXOpen.Assemblies.Component s to reorder and the target NXOpen.Assemblies.Component should be children of the same immediate parent.

Created in NX9.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

order	NXOpen.Assemblies.ComponentOrder in which components are reordered
componentsToReorder	Array of components to be reordered
targetComponent	Components are moved before or after this component
beforeOrAfter	Whether to move components before or after the target component

unsafe void NXOpen.Assemblies.ComponentAssembly.ReplaceReferenceSet	(	NXOpen.Assemblies.Component	component,
		string	newReferenceSet
	)

Replaces the reference set used by a component.

Note that the names of the default reference sets Empty and Entire Part can be obtained from NXOpen.Assemblies.Component.EmptyPartRefsetName or NXOpen.Assemblies.Component.EntirePartRefsetName .

Created in NX3.0.0

License requirements: None.

Parameters

component	The component to edit. Must be directly owned by this assembly.
newReferenceSet	The name of the new reference set

unsafe NXOpen.ErrorList NXOpen.Assemblies.ComponentAssembly.ReplaceReferenceSetInOwners	(	string	newReferenceSet,
		NXOpen.Assemblies.Component[]	components
	)

Sets the reference set used to represent each component in an array.

This is the equivalent of calling:

<see cref="NXOpen.Assemblies.Component.DirectOwner"> NXOpen.Assemblies.Component.DirectOwner </see>

<see cref="NXOpen.Assemblies.ComponentAssembly.ReplaceReferenceSet"> NXOpen.Assemblies.ComponentAssembly.ReplaceReferenceSet </see>

on each component in the array. However, this method will ensure that the reference set operations are carried out in the correct order, so that any effects caused by a parent's reference set change will be correctly reflected in the children. If changing reference set on components at various levels in the assembly, use this method.

Note that the names of the default reference sets Empty and Entire Part can be obtained from NXOpen.Assemblies.Component.EmptyPartRefsetName or NXOpen.Assemblies.Component.EntirePartRefsetName .

Created in NX3.0.0

License requirements: None.

Parameters

newReferenceSet	The name of the new reference set
components	Components to be edited. Each component will have its reference set updated in its owning assembly.

Returns: list of errors encountered during the edit

unsafe void NXOpen.Assemblies.ComponentAssembly.RestructureComponents	(	NXOpen.Assemblies.Component[]	origComponents,
		NXOpen.Assemblies.Component	newParentComponent,
		bool	deleteFlag,
		out NXOpen.Assemblies.Component[]	newComponents,
		out NXOpen.ErrorList	errorList
	)

Given an array of components and a specified parent this function will transfer the given components to the parent.

The original components do not need to be under the same parent assembly as each other.

The number of new components may be different from the original number of components if problems occurred during the transfer

Created in NX6.0.1

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

origComponents	Array of components to be restructured
newParentComponent	Destination for restructure
deleteFlag	Flag to delete original components
newComponents	Restructured components
errorList	Any errors that occurred during the restructure

unsafe void NXOpen.Assemblies.ComponentAssembly.SetAsRequiredQuantity ( NXOpen.Assemblies.Component component )

Sets the as-required quantity on this component.

Created in NX6.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

component The component to edit. Must be directly owned by this assembly.

unsafe void NXOpen.Assemblies.ComponentAssembly.SetDefault ( NXOpen.Assemblies.Arrangement arrangement )

Set the default NXOpen.Assemblies.Arrangement for the given NXOpen.Assemblies.ComponentAssembly .

Created in NX7.5.2

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

arrangement The new default NXOpen.Assemblies.Arrangement .

unsafe void NXOpen.Assemblies.ComponentAssembly.SetEmptyRefset ( NXOpen.Assemblies.Component component )

Convenience method for setting the reference set used to represent a component to be empty

Created in NX3.0.0

License requirements: None.

Parameters

component The component to edit. Must be directly owned by this assembly.

unsafe void NXOpen.Assemblies.ComponentAssembly.SetEntirePartRefset ( NXOpen.Assemblies.Component component )

Convenience method for setting the reference set used to represent a component to be the entire part.

Created in NX3.0.0

License requirements: None.

Parameters

component The component to edit. Must be directly owned by this assembly.

unsafe void NXOpen.Assemblies.ComponentAssembly.SetIntegerQuantity	(	NXOpen.Assemblies.Component	component,
		int	integerQuantity
	)

Sets the integer quantity on this component.

Created in NX6.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

component	The component to edit. Must be directly owned by this assembly.
integerQuantity	Integer quantity value

unsafe void NXOpen.Assemblies.ComponentAssembly.SetNonGeometricState	(	NXOpen.Assemblies.Component	component,
		bool	nonGeometricState
	)

Sets the component state to Geometric or Non-Geometric.

Component which are made non-geometric are undrawn from graphics area.

Created in NX6.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

component	The component to edit. Must be directly owned by this assembly.
nonGeometricState	True to make component non-geometric, false otherwise

unsafe void NXOpen.Assemblies.ComponentAssembly.SetRealQuantity	(	NXOpen.Assemblies.Component	component,
		double	realQuantity,
		string	quantityUnits
	)

Sets the real quantity and corresponding units on this component.

Created in NX6.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

component	The component to edit. Must be directly owned by this assembly.
realQuantity	Real quantity value
quantityUnits	Units

unsafe NXOpen.ErrorList NXOpen.Assemblies.ComponentAssembly.ShowComponentsInIsolateView	(	NXOpen.Assemblies.Component[]	components,
		out NXOpen.View	view
	)

Shows array of components in Isolate view NXOpen.View .

If Isolate view doesn't exist then this API doesn't do anything. Returns NXOpen.View which is treated as Isolate View.

Created in NX11.0.1

License requirements: gateway ("UG GATEWAY")

Parameters

components	Array of components to be shown in isolate view
view	Return the isolate view

Returns: list of errors encountered during components shown in isolate view

unsafe NXOpen.Assemblies.Component NXOpen.Assemblies.ComponentAssembly.SubstituteComponent	(	NXOpen.Assemblies.Component	component,
		NXOpen.BasePart	part,
		string	newName,
		string	referenceSet,
		int	layer,
		NXOpen.Assemblies.ComponentAssembly.SubstitutionMode	mode
	)

Substitutes an old component with a new component.

The new component represents a new part, but will be placed in the same location as the original.

Created in NX3.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

component	The old component to be substituted.
part	The new part
newName	The name for the new component
referenceSet	The name of the reference set for the new component
layer	The layer for the new component -1 means use the original layers defined in the component. 0 means use the work layer 1-256 means use the specified layer.
mode	Defines the substitution mode

Returns: The new Component that replaces the old one.

unsafe NXOpen.ErrorList NXOpen.Assemblies.ComponentAssembly.SuppressComponents	(	NXOpen.Assemblies.Component[]	components,
		NXOpen.Assemblies.Arrangement[]	arrangements
	)

Suppresses an array of components

Created in NX3.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

components	NXOpen.Assemblies.Component s to be suppressed
arrangements	Arrangements in which components should be suppressed. These arrangements must be defined in this ComponentAssembly

Returns: list of errors encountered during the suppress

unsafe NXOpen.ErrorList NXOpen.Assemblies.ComponentAssembly.SuppressComponents ( NXOpen.Assemblies.Component[] components )

Suppresses an array of components in all NXOpen.Assemblies.Arrangement s in this ComponentAssembly

Created in NX3.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

components NXOpen.Assemblies.Component s to be suppressed

Returns: list of errors encountered during the suppress

unsafe NXOpen.ErrorList NXOpen.Assemblies.ComponentAssembly.SuppressComponents	(	NXOpen.Assemblies.Component[]	components,
		NXOpen.Assemblies.Arrangement[]	arrangements,
		string	expression
	)

Suppresses an array of components in all NXOpen.Assemblies.Arrangement s in this ComponentAssembly

Created in NX5.0.1

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

components	NXOpen.Assemblies.Component s to be suppressed
arrangements	Arrangements in which components should be unsuppressed
expression	Suppress components if expression evalutes zero else unsuppress components

Returns: list of errors encountered during the suppress

unsafe NXOpen.ErrorList NXOpen.Assemblies.ComponentAssembly.UnsuppressComponents	(	NXOpen.Assemblies.Component[]	components,
		NXOpen.Assemblies.Arrangement[]	arrangements
	)

Unsuppresses an array of components in this ComponentAssembly

Created in NX3.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

components	NXOpen.Assemblies.Component s to be unsuppressed
arrangements	Arrangements in which components should be unsuppressed. These arrangements must be defined in this ComponentAssembly

Returns: list of errors encountered during the unsuppress

unsafe NXOpen.ErrorList NXOpen.Assemblies.ComponentAssembly.UnsuppressComponents ( NXOpen.Assemblies.Component[] components )

Unsuppresses an array of components in all NXOpen.Assemblies.Arrangement s in this ComponentAssembly

Created in NX3.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

Parameters

components NXOpen.Assemblies.Component s to be unsuppressed

Returns: list of errors encountered during the unsuppress

Property Documentation

unsafe NXOpen.Assemblies.Arrangement NXOpen.Assemblies.ComponentAssembly.ActiveArrangement

getset

Returns or sets the currently active NXOpen.Assemblies.Arrangement for this ComponentAssembly

Created in NX3.0.0

License requirements to get this property: assemblies ("ASSEMBLIES MODULE")

License requirements to set this property: assemblies ("ASSEMBLIES MODULE")

NXOpen.Assemblies.ArrangementCollection NXOpen.Assemblies.ComponentAssembly.Arrangements

get

The collection of NXOpen.Assemblies.Arrangement s defined in the ComponentAssembly

Created in NX3.0.0

NXOpen.Assemblies.ClearanceSetCollection NXOpen.Assemblies.ComponentAssembly.ClearanceSets

get

The collection of NXOpen.Assemblies.ClearanceSet s defined in the ComponentAssembly

Created in NX9.0.0

NXOpen.Assemblies.ComponentPatternCollection NXOpen.Assemblies.ComponentAssembly.ComponentPatterns

get

The collection of NXOpen.Assemblies.ComponentPattern defined in the ComponentAssembly

Created in NX9.0.0

NXOpen.Assemblies.DrawingExplosionCollection NXOpen.Assemblies.ComponentAssembly.DrawingExplosions

get

The collection of NXOpen.Assemblies.DrawingExplosion s defined in the ComponentAssembly

Created in NX12.0.0

NXOpen.Assemblies.ExplosionCollection NXOpen.Assemblies.ComponentAssembly.Explosions

get

The collection of NXOpen.Assemblies.Explosion s defined in the ComponentAssembly

Created in NX3.0.0

NXOpen.Assemblies.OrderCollection NXOpen.Assemblies.ComponentAssembly.OrdersSet

get

The collection of NXOpen.Assemblies.Order s defined in the ComponentAssembly

Created in NX9.0.0

unsafe NXOpen.Positioning.ComponentPositioner NXOpen.Assemblies.ComponentAssembly.Positioner

get

Returns the component positioner for this assembly.

The positioner manages the component constraints.

Created in NX4.0.0

License requirements: assemblies ("ASSEMBLIES MODULE")

unsafe NXOpen.Assemblies.Component NXOpen.Assemblies.ComponentAssembly.RootComponent

get

Returns the top-level component, i.e.

the component at the root of the component tree.

This component corresponds to the part that owns this NXOpen.Assemblies.ComponentAssembly . The components below this will correspond to parts added by calling NXOpen.Assemblies.ComponentAssembly.AddComponent .

Note that this will be a null reference (Nothing in Visual Basic) if there are no components in the tree. (I.e. if the part that owns this ComponentAssembly is a piece part.)

Created in NX3.0.0

License requirements: None.

NXOpen.Assemblies.SubsetCollection NXOpen.Assemblies.ComponentAssembly.Subsets

get

The collection of NXOpen.Assemblies.Subset s defined in the ComponentAssembly

Created in NX8.5.0

The documentation for this class was generated from the following file:

dotnet_pool/Assemblies_ComponentAssembly.cs

Public Types

Public Member Functions

Properties

Detailed Description

Member Enumeration Documentation

Member Function Documentation

Property Documentation