Represents a Edge Blend builder. More...

Inheritance diagram for NXOpen::Features::EdgeBlendBuilder:

Public Types
enum	Conic { ConicBoundaryPlusCenter, ConicBoundaryPlusRho, ConicCenterPlusRho }
	This enum represents the Conic option. More...

enum	FaceContinuity { FaceContinuityTangent, FaceContinuityCurvature }
	The Blend Face Continuity. More...

enum	OrderOfBlending { OrderOfBlendingConvexFirst, OrderOfBlendingConcaveFirst }
	This enum represents the order of Blending. More...

enum	Overlap { OverlapMaintainAndIntersect, OverlapDifferentConvexityRollOver, OverlapAnyConvexityRollOver }
	This enum represents the Overlap resolution options for Edge Blend. More...

enum	Rhotype { RhotypeRelative, RhotypeAbsolute }
	This enum represents the rho type for conic section blend. More...

enum	Section { SectionCircular, SectionConic }
	This enum represents the Section option. More...

enum	Setback { SetbackIncludeWithCorner, SetbackSeparateFromCorner }
	This enum represents the Setback option. More...

Public Member Functions
int	AddChainset (NXOpen::ScCollector *collector, const NXString &radius)
	Add an edge blend chainset to the edge blend. More...

int	AddChainset (NXOpen::ScCollector collector, const char radius)
	Add an edge blend chainset to the edge blend. More...

int	AddChainset (NXOpen::ScCollector *collector, NXOpen::Features::EdgeBlendBuilder::Section sectionType, NXOpen::Features::EdgeBlendBuilder::Conic conicMethod, NXOpen::Features::EdgeBlendBuilder::Rhotype rhoType, const NXString &radius, const NXString &center, const NXString &rho)
	Add an edge blend chainset to the edge blend. More...

int	AddChainset (NXOpen::ScCollector collector, NXOpen::Features::EdgeBlendBuilder::Section sectionType, NXOpen::Features::EdgeBlendBuilder::Conic conicMethod, NXOpen::Features::EdgeBlendBuilder::Rhotype rhoType, const char radius, const char center, const char rho)
	Add an edge blend chainset to the edge blend. More...

void	AddEdgeChainData (const std::vector< NXOpen::Edge * > &edgeArray, const std::vector< bool > &edgeAlongChainDirectionArray, bool isChainClosed, bool isChainPartOfNetwork)
	Add an edge blend edge chain data to the edge blend Created in NX11.0.1. More...

int	AddNewStopshortData (NXOpen::GeometricUtilities::BlendStopshortBuilder *builder)
	Add an edge blend stop short data for an edge in the edge blend. More...

void	AddPointOnEdgeChainData (const std::vector< NXOpen::Edge * > &edgeArray, double parameterOnChain, bool isArclength, double radius, double centerValue, double rhoValue, NXOpen::Point *smartPoint, bool isExternal)
	Add a point on edge chain data to the edge blend Created in NX11.0.1. More...

int	AddSetbackData (const std::vector< NXOpen::Edge * > &edgeArray, const std::vector< bool > &fromStart, const std::vector< NXString > &distance)
	Add an edge blend setback data for an edge in the edge blend. More...

int	AddStopshortData (NXOpen::Edge *edge, bool fromStart, const NXString &distance)
	Add an edge blend stop short data for an edge in the edge blend. More...

int	AddStopshortData (NXOpen::Edge edge, bool fromStart, const char distance)
	Add an edge blend stop short data for an edge in the edge blend. More...

int	AddVariablePointData (NXOpen::Edge edge, const NXString &parameter, const NXString &radius, const NXString &centerValue, const NXString &rhoValue, NXOpen::Point smartPoint, bool isExternal, bool isArclength)
	Add an edge blend variable radius data for an edge in the edge blend. More...

int	AddVariablePointData (NXOpen::Edge edge, const char parameter, const char radius, const char centerValue, const char rhoValue, NXOpen::Point smartPoint, bool isExternal, bool isArclength)
	Add an edge blend variable radius data for an edge in the edge blend. More...

int	AddVariableRadiusData (NXOpen::Edge edge, double parameter, const NXString &radius, NXOpen::Point smartPoint, bool isExternal)
	Add an edge blend variable radius data for an edge in the edge blend. More...

int	AddVariableRadiusData (NXOpen::Edge edge, double parameter, const char radius, NXOpen::Point *smartPoint, bool isExternal)
	Add an edge blend variable radius data for an edge in the edge blend. More...

int	AddVariableRadiusDataNew (NXOpen::Edge edge, const NXString &parameter, const NXString &radius, NXOpen::Point smartPoint, bool isExternal)
	Add an edge blend variable radius data for an edge in the edge blend Note: This ja will always create arclength parameter. More...

int	AddVariableRadiusDataNew (NXOpen::Edge edge, const char parameter, const char radius, NXOpen::Point smartPoint, bool isExternal)
	Add an edge blend variable radius data for an edge in the edge blend Note: This ja will always create arclength parameter. More...

int	AddVariableRadiusDataNew (NXOpen::Edge edge, const NXString &parameter, const NXString &radius, NXOpen::Point smartPoint, bool isExternal, bool isArclength)
	Add an edge blend variable radius data for an edge in the edge blend. More...

int	AddVariableRadiusDataNew (NXOpen::Edge edge, const char parameter, const char radius, NXOpen::Point smartPoint, bool isExternal, bool isArclength)
	Add an edge blend variable radius data for an edge in the edge blend. More...

bool	AllInstancesOption ()
	Returns the blend all instances option. More...

NXOpen::Features::EdgeBlendBuilder::FaceContinuity	BlendFaceContinuity ()
	Returns the Blend Face Continuity option Created in NX10.0.0. More...

NXOpen::Features::EdgeBlendBuilder::OrderOfBlending	BlendOrder ()
	Returns the order of blending for edge blend Created in NX4.0.0. More...

NXOpen::ScCollector *	CliffEdges ()
	Returns the forced cliff edges for edge blend Created in NX5.0.0. More...

bool	ConvexConcaveY ()
	Returns the Special blend at convex / concave Y option. More...

void	EditVariablePointData (NXOpen::Edge edge, int vrIndex, const NXString &parameter, const NXString &radius, const NXString &centerValue, const NXString &rhoValue, NXOpen::Point smartPoint, bool isExternal, bool isArclength)
	Edit an edge blend variable radius data for an edge in the edge blend Created in NX8.0.0. More...

void	EditVariablePointData (NXOpen::Edge edge, int vrIndex, const char parameter, const char radius, const char centerValue, const char rhoValue, NXOpen::Point smartPoint, bool isExternal, bool isArclength)
	Edit an edge blend variable radius data for an edge in the edge blend Created in NX8.0.0. More...

void	EditVariableRadiusData (NXOpen::Edge edge, int vrIndex, double parameter, const NXString &radius, NXOpen::Point smartPoint, bool isExternal)
	Edit an edge blend variable radius data for an edge in the edge blend More...

void	EditVariableRadiusData (NXOpen::Edge edge, int vrIndex, double parameter, const char radius, NXOpen::Point *smartPoint, bool isExternal)
	Edit an edge blend variable radius data for an edge in the edge blend More...

void	EditVariableRadiusDataNew (NXOpen::Edge edge, int vrIndex, const NXString &parameter, const NXString &radius, NXOpen::Point smartPoint, bool isExternal)
	Edit an edge blend variable radius data for an edge in the edge blend Created in NX6.0.0. More...

void	EditVariableRadiusDataNew (NXOpen::Edge edge, int vrIndex, const char parameter, const char radius, NXOpen::Point smartPoint, bool isExternal)
	Edit an edge blend variable radius data for an edge in the edge blend Created in NX6.0.0. More...

void	EditVariableRadiusDataNew (NXOpen::Edge edge, int vrIndex, const NXString &parameter, const NXString &radius, NXOpen::Point smartPoint, bool isExternal, bool isArclength)
	Edit an edge blend variable radius data for an edge in the edge blend Created in NX6.0.0. More...

void	EditVariableRadiusDataNew (NXOpen::Edge edge, int vrIndex, const char parameter, const char radius, NXOpen::Point smartPoint, bool isExternal, bool isArclength)
	Edit an edge blend variable radius data for an edge in the edge blend Created in NX6.0.0. More...

void	GetChainset (int csIndex, NXOpen::ScCollector collector, NXOpen::Expression radius)
	Get collector and radius for an edge blend chainset given the index of the chainset Created in NX4.0.0. More...

void	GetChainsetAndSectionValue (int csIndex, NXOpen::ScCollector *collector, NXOpen::Features::EdgeBlendBuilder::Section sectionType, NXOpen::Features::EdgeBlendBuilder::Conic conicMethod, NXOpen::Features::EdgeBlendBuilder::Rhotype rhoType, NXOpen::Expression radius, NXOpen::Expression centerValueTAG, NXOpen::Expression **rhoValueTAG)
	Get collector, radius and section types for an edge blend chainset given the index of the chainset Created in NX10.0.3. More...

void	GetChainsetAndStatus (int csIndex, NXOpen::ScCollector collector, NXOpen::Expression radius, bool *isValid)
	Get collector, radius and validity status for an edge blend chainset given the index of the chainset Created in NX5.0.0. More...

int	GetChainsetIndex (NXOpen::ScCollector *collector)
	Get the index of edge blend chainset given the collector. More...

NXOpen::GeometricUtilities::BlendStopshortBuilder *	GetNewStopshortData (int ssIndex)
	Get an edge blend stop short data for the index provided. More...

int	GetNumberOfValidChainsets ()
	Get the number of valid chainsets. More...

std::vector< NXOpen::Edge * >	GetSetbackData (int sbIndex, std::vector< bool > &fromStart, std::vector< NXOpen::Expression * > &distanceExp)
	Get an edge blend setback data for the index provided. More...

NXOpen::Expression *	GetStopshortData (int ssIndex, NXOpen::Edge *edge, bool fromStart)
	Get an edge blend stop short data for the index provided. More...

std::vector< double >	GetVariableRadiusData (NXOpen::Edge edge, std::vector< NXOpen::Expression > &radiiExp, std::vector< NXOpen::Point * > &smartPoints, std::vector< bool > &isExternalFlagArray)
	Get all the variable radii data for an edge in the edge blend. More...

void	GetVariableRadiusDataNew (NXOpen::Edge edge, std::vector< NXOpen::Expression > &parameterExp, std::vector< NXOpen::Expression * > &radiiExp, std::vector< NXOpen::Point * > &smartPoints, std::vector< bool > &isExternalFlagArray)
	Get all the variable radii data for an edge in the edge blend Created in NX6.0.0. More...

bool	LimitFailingAreas ()
	Returns the Limit Failing Areas option. More...

NXOpen::GeometricUtilities::BlendLimitsData *	LimitsListData ()
	Returns the limits list Created in NX5.0.0. More...

bool	MoveSharpEdge ()
	Returns the Maintain blend and move sharp edges option. More...

NXOpen::ScCollector *	NonCliffEdges ()
	Returns the prohibited cliff edges for edge blend Created in NX5.0.0. More...

NXOpen::Features::EdgeBlendBuilder::Overlap	OverlapOption ()
	Returns the overlap resolution for edge blend Created in NX4.0.0. More...

bool	PatchComplexGeometryAreas ()
	Returns the Patch Areas option. More...

void	RemoveChainset (int csIndex)
	Delete an edge blend chainset from the edge blend. More...

void	RemoveChainsetByCollector (NXOpen::ScCollector *collector)
	Delete an edge blend chainset from the edge blend. More...

void	RemoveEdgeChainAndPointOnEdgeChainData ()
	Remove all existing edge chain data and point on edge chain data Created in NX11.0.1. More...

void	RemoveNewStopshortData (NXOpen::GeometricUtilities::BlendStopshortBuilder *builder)
	Remove an edge blend stop short corresponding to a BlendStopshortBuilder Created in NX5.0.0. More...

bool	RemoveSelfIntersection ()
	Returns the Remove self-intersection option. More...

void	RemoveSetbackData (int sbIndex)
	Remove an edge blend setback data for an edge in the edge blend Created in NX4.0.0. More...

void	RemoveStopshortData (NXOpen::Edge *edge, bool fromStart)
	Remove an edge blend stop short data for an edge More...

void	RemoveStopshortData (int ssIndex)
	Remove an edge blend stop short data for the index indicated More...

void	RemoveStopshortDataByType (NXOpen::Edge *edge, bool fromStart, NXOpen::GeometricUtilities::BlendStopshortBuilder::Choices type)
	Remove the stop short from an edge, given its type and location Created in NX5.0.0. More...

void	RemoveVariableRadiusData (NXOpen::Edge *edge, double parameter)
	Remove variable radius data on an edge by the parameter value of the point on the edge Created in NX4.0.0. More...

void	RemoveVariableRadiusData (NXOpen::Edge *edge)
	Remove all variable radius datas on an edge Created in NX4.0.0. More...

void	RemoveVariableRadiusDataByIndex (NXOpen::Edge *edge, int index)
	Remove variable radius data on an edge by the index into the point array on the edge Created in NX4.0.0. More...

bool	RollOntoEdge ()
	Returns the Roll onto edges option. More...

bool	RollOverSmoothEdge ()
	Returns the Roll over smooth edges option. More...

bool	SegmentBlendFaces ()
	Returns the Segment blend to match face segments option Created in NX10.0.0. More...

void	SetAllInstancesOption (bool optionValue)
	Sets the blend all instances option. More...

NXOpen::Features::EdgeBlendBuilder::Setback	SetbackOption ()
	Returns the setback option for edge blend Created in NX4.0.0. More...

void	SetBlendFaceContinuity (NXOpen::Features::EdgeBlendBuilder::FaceContinuity optionValue)
	Sets the Blend Face Continuity option Created in NX10.0.0. More...

void	SetBlendOrder (NXOpen::Features::EdgeBlendBuilder::OrderOfBlending blendOrder)
	Sets the order of blending for edge blend Created in NX4.0.0. More...

void	SetCliffEdges (NXOpen::ScCollector *cliffEdgeCollector)
	Sets the forced cliff edges for edge blend Created in NX5.0.0. More...

void	SetConvexConcaveY (bool optionValue)
	Sets the Special blend at convex / concave Y option. More...

void	SetLimitFailingAreas (bool optionValue)
	Sets the Limit Failing Areas option. More...

void	SetMoveSharpEdge (bool optionValue)
	Sets the Maintain blend and move sharp edges option. More...

void	SetNonCliffEdges (NXOpen::ScCollector *nonCliffEdgeCollector)
	Sets the prohibited cliff edges for edge blend Created in NX5.0.0. More...

void	SetOverlapOption (NXOpen::Features::EdgeBlendBuilder::Overlap overlapOption)
	Sets the overlap resolution for edge blend Created in NX4.0.0. More...

void	SetPatchComplexGeometryAreas (bool optionValue)
	Sets the Patch Areas option. More...

void	SetRemoveSelfIntersection (bool optionValue)
	Sets the Remove self-intersection option. More...

void	SetRollOntoEdge (bool optionValue)
	Sets the Roll onto edges option. More...

void	SetRollOverSmoothEdge (bool optionValue)
	Sets the Roll over smooth edges option. More...

void	SetSegmentBlendFaces (bool optionValue)
	Sets the Segment blend to match face segments option Created in NX10.0.0. More...

void	SetSetbackOption (NXOpen::Features::EdgeBlendBuilder::Setback setbackOption)
	Sets the setback option for edge blend Created in NX4.0.0. More...

void	SetTolerance (double tolerance)
	Sets the tolerance of a variable blend. More...

void	SetTrimmingOption (bool optionValue)
	Sets the trimming option. More...

void	SetZeroSlopeRadiusFunctionAtChainEnds (bool optionValue)
	Sets the zero slope radius function at chain ends option Created in NX10.0.1. More...

double	Tolerance ()
	Returns the tolerance of a variable blend. More...

bool	TrimmingOption ()
	Returns the trimming option. More...

bool	ZeroSlopeRadiusFunctionAtChainEnds ()
	Returns the zero slope radius function at chain ends option Created in NX10.0.1. More...

Public Member Functions inherited from NXOpen::Features::FeatureBuilder
NXOpen::Features::Feature *	CommitFeature ()
	Commits the feature parameters and creates the feature. More...

NXOpen::Features::Feature *	GetFeature ()
	Returns the feature currently being edited by this builder. More...

void	HideInternalParentFeatureAfterEdit (NXOpen::Features::Feature *parentFeature)
	Re-suppress an internal parent feature (a slave feature) after it has been edited. More...

bool	ParentFeatureInternal ()
	Returns whether or not the latest timestamped parent feature of this feature should be made internal Created in NX5.0.0. More...

bool	PatchSolutionFlag ()
	Returns the patch solution flag Created in NX8.0.1. More...

NXString	PatchSurfaceFilename ()
	Returns the patch surface filename Created in NX8.0.1. More...

void	SetParentFeatureInternal (NXOpen::Features::Feature *parentFeature)
	Set the parent features which would be internal or slaves to the feature being created or commited Created in NX6.0.0. More...

void	SetParentFeatureInternal (bool isInternal)
	Sets whether or not the latest timestamped parent feature of this feature should be made internal Created in NX5.0.0. More...

void	SetPatchSolutionFlag (bool optionValue)
	Sets the patch solution flag Created in NX8.0.1. More...

void	SetPatchSurfaceFilename (const NXString &surfaceFilename)
	Sets the patch surface filename Created in NX8.0.1. More...

void	SetPatchSurfaceFilename (const char *surfaceFilename)
	Sets the patch surface filename Created in NX8.0.1. More...

void	SetSurroundingPatchSurfaceFilename (const NXString &surroundingSurfaceFilename)
	Sets the surrounding patch surface filename Created in NX8.0.1. More...

void	SetSurroundingPatchSurfaceFilename (const char *surroundingSurfaceFilename)
	Sets the surrounding patch surface filename Created in NX8.0.1. More...

void	ShowInternalParentFeatureForEdit (NXOpen::Features::Feature *parentFeature)
	Unsuppress an internal parent feature (a slave feature) so it can be edited. More...

NXString	SurroundingPatchSurfaceFilename ()
	Returns the surrounding patch surface filename Created in NX8.0.1. More...

void	UnsetParentFeatureInternal (NXOpen::Features::Feature *parentFeature)
	Set the internal parent feature of the feature being edited to external Created in NX6.0.0. More...

Public Member Functions inherited from NXOpen::Builder
NXOpen::NXObject *	Commit ()
	Commits any edits that have been applied to the builder. More...

void	Destroy ()
	Deletes the builder, and cleans up any objects created by the builder. More...

std::vector< NXOpen::NXObject * >	GetCommittedObjects ()
	For builders that create more than one object, this method returns the objects that are created by commit. More...

NXOpen::NXObject *	GetObject ()
	Returns the object currently being edited by this builder. More...

void	ShowResults ()
	Updates the model to reflect the result of an edit to the model for all builders that support showing results. More...

virtual bool	Validate ()
	Validate whether the inputs to the component are sufficient for commit to be called. More...

Public Member Functions inherited from NXOpen::TaggedObject
tag_t	Tag () const
	Returns the tag of this object. More...

Detailed Description

Represents a Edge Blend builder.

To create a new instance of this class, use NXOpen::Features::FeatureCollection::CreateEdgeBlendBuilder
Default values.

Property

Value

TrimmingOption

False

Created in NX4.0.0.

Member Enumeration Documentation

enum NXOpen::Features::EdgeBlendBuilder::Conic

This enum represents the Conic option.

Enumerator
ConicBoundaryPlusCenter	boundary plus center
ConicBoundaryPlusRho	boundary plus rho
ConicCenterPlusRho	center plus rho

enum NXOpen::Features::EdgeBlendBuilder::FaceContinuity

The Blend Face Continuity.

Enumerator
FaceContinuityTangent	tangent
FaceContinuityCurvature	curvature

enum NXOpen::Features::EdgeBlendBuilder::OrderOfBlending

This enum represents the order of Blending.

Enumerator
OrderOfBlendingConvexFirst	Convex first.
OrderOfBlendingConcaveFirst	Concave first.

enum NXOpen::Features::EdgeBlendBuilder::Overlap

This enum represents the Overlap resolution options for Edge Blend.

Enumerator
OverlapMaintainAndIntersect	Maintain Blend and Intersect.
OverlapDifferentConvexityRollOver	If different convexity,roll over.
OverlapAnyConvexityRollOver	Any convexity,roll over.

enum NXOpen::Features::EdgeBlendBuilder::Rhotype

This enum represents the rho type for conic section blend.

Enumerator
RhotypeRelative	relative
RhotypeAbsolute	absolute

enum NXOpen::Features::EdgeBlendBuilder::Section

This enum represents the Section option.

Enumerator
SectionCircular	Default option, circular shaped blends.
SectionConic	Conical shaped blends.

enum NXOpen::Features::EdgeBlendBuilder::Setback

This enum represents the Setback option.

Enumerator
SetbackIncludeWithCorner	Include with corner.
SetbackSeparateFromCorner	Separate from corner.

Member Function Documentation

int NXOpen::Features::EdgeBlendBuilder::AddChainset	(	NXOpen::ScCollector *	collector,
		const NXString &	radius
	)

Add an edge blend chainset to the edge blend.

Returns: Index of chainset, indicating which chainset we are dealing with
Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

collector	The collector for this edge blend chainset
radius	The radius of this chain set collector

int NXOpen::Features::EdgeBlendBuilder::AddChainset	(	NXOpen::ScCollector *	collector,
		const char *	radius
	)

Add an edge blend chainset to the edge blend.

Returns: Index of chainset, indicating which chainset we are dealing with
Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

collector	The collector for this edge blend chainset
radius	The radius of this chain set collector

int NXOpen::Features::EdgeBlendBuilder::AddChainset	(	NXOpen::ScCollector *	collector,
		NXOpen::Features::EdgeBlendBuilder::Section	sectionType,
		NXOpen::Features::EdgeBlendBuilder::Conic	conicMethod,
		NXOpen::Features::EdgeBlendBuilder::Rhotype	rhoType,
		const NXString &	radius,
		const NXString &	center,
		const NXString &	rho
	)

Add an edge blend chainset to the edge blend.

Returns: Index of chainset, indicating which chainset we are dealing with
Created in NX8.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

collector	The collector for this edge blend chainset
sectionType	Shape specifier for this chainset
conicMethod	Shape subtype specifier for this chainset
rhoType	rho type for this chain set
radius	The radius of this chain set collector
center	The conic center value of this chain set collector if type is Conic
rho	The conic rho value of this chain set collector if type is Conic

int NXOpen::Features::EdgeBlendBuilder::AddChainset	(	NXOpen::ScCollector *	collector,
		NXOpen::Features::EdgeBlendBuilder::Section	sectionType,
		NXOpen::Features::EdgeBlendBuilder::Conic	conicMethod,
		NXOpen::Features::EdgeBlendBuilder::Rhotype	rhoType,
		const char *	radius,
		const char *	center,
		const char *	rho
	)

Add an edge blend chainset to the edge blend.

Returns: Index of chainset, indicating which chainset we are dealing with
Created in NX8.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

collector	The collector for this edge blend chainset
sectionType	Shape specifier for this chainset
conicMethod	Shape subtype specifier for this chainset
rhoType	rho type for this chain set
radius	The radius of this chain set collector
center	The conic center value of this chain set collector if type is Conic
rho	The conic rho value of this chain set collector if type is Conic

void NXOpen::Features::EdgeBlendBuilder::AddEdgeChainData	(	const std::vector< NXOpen::Edge * > &	edgeArray,
		const std::vector< bool > &	edgeAlongChainDirectionArray,
		bool	isChainClosed,
		bool	isChainPartOfNetwork
	)

Add an edge blend edge chain data to the edge blend
Created in NX11.0.1.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edgeArray	Array of edges that are used by the edge chain
edgeAlongChainDirectionArray	Array of chain edge along chain direction flags
isChainClosed	is the edge chain closed or not
isChainPartOfNetwork	is the edge chain part of chain network (junction) or not

int NXOpen::Features::EdgeBlendBuilder::AddNewStopshortData ( NXOpen::GeometricUtilities::BlendStopshortBuilder * builder )

Add an edge blend stop short data for an edge in the edge blend.

Returns: Index of where stop short data item is created.
Created in NX5.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

builder the Stopshort Data

void NXOpen::Features::EdgeBlendBuilder::AddPointOnEdgeChainData	(	const std::vector< NXOpen::Edge * > &	edgeArray,
		double	parameterOnChain,
		bool	isArclength,
		double	radius,
		double	centerValue,
		double	rhoValue,
		NXOpen::Point *	smartPoint,
		bool	isExternal
	)

Add a point on edge chain data to the edge blend
Created in NX11.0.1.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edgeArray	Array of edges that are used by the edge chain
parameterOnChain	The variable radius point parameter along the chain. If isArcLength is false, this value is a percentage value
isArclength	Flag indicating whether parameter is arclength or percentage arclength
radius	The radius at this point on the edge.
centerValue	The conic center value at this point on the edge.
rhoValue	The conic rho value at this point on the edge.
smartPoint	Smart Point defining the location of this variable radius
isExternal	Flag indicating whether this point is external to blend

int NXOpen::Features::EdgeBlendBuilder::AddSetbackData	(	const std::vector< NXOpen::Edge * > &	edgeArray,
		const std::vector< bool > &	fromStart,
		const std::vector< NXString > &	distance
	)

Add an edge blend setback data for an edge in the edge blend.

Returns: Index of where setback data item is created.
Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edgeArray	Array of Edge collector tags that are used by the setback
fromStart	if true, then the setback is defined at the start vertex. Otherwise, it is defined at the end vertex. There is one for each input edge.
distance	Array of distances

int NXOpen::Features::EdgeBlendBuilder::AddStopshortData	(	NXOpen::Edge *	edge,
		bool	fromStart,
		const NXString &	distance
	)

Add an edge blend stop short data for an edge in the edge blend.

Returns: Index of where stop short data item is created.

Deprecated:: Deprecated in NX5.0.0. Use Features::EdgeBlendBuilder::AddNewStopshortData instead.

Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
fromStart	if true, then the stopshort is defined at the start vertex. Otherwise, it is defined at the end vertex.
distance	The distance for the stopshort on the edge.

int NXOpen::Features::EdgeBlendBuilder::AddStopshortData	(	NXOpen::Edge *	edge,
		bool	fromStart,
		const char *	distance
	)

Add an edge blend stop short data for an edge in the edge blend.

Returns: Index of where stop short data item is created.

Deprecated:: Deprecated in NX5.0.0. Use Features::EdgeBlendBuilder::AddNewStopshortData instead.

Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
fromStart	if true, then the stopshort is defined at the start vertex. Otherwise, it is defined at the end vertex.
distance	The distance for the stopshort on the edge.

int NXOpen::Features::EdgeBlendBuilder::AddVariablePointData	(	NXOpen::Edge *	edge,
		const NXString &	parameter,
		const NXString &	radius,
		const NXString &	centerValue,
		const NXString &	rhoValue,
		NXOpen::Point *	smartPoint,
		bool	isExternal,
		bool	isArclength
	)

Add an edge blend variable radius data for an edge in the edge blend.

Returns: Index of where variable radius data item is created
Created in NX8.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
parameter	Parameter location of point on the edge
radius	The radius at this point on the edge.
centerValue	The conic center value at this point on the edge.
rhoValue	The conic rho value at this point on the edge.
smartPoint	Smart Point defining the location of this vr
isExternal	Flag indicating whether this point is external to blend
isArclength	Flag indicating whether parameter is arclength or not

int NXOpen::Features::EdgeBlendBuilder::AddVariablePointData	(	NXOpen::Edge *	edge,
		const char *	parameter,
		const char *	radius,
		const char *	centerValue,
		const char *	rhoValue,
		NXOpen::Point *	smartPoint,
		bool	isExternal,
		bool	isArclength
	)

Add an edge blend variable radius data for an edge in the edge blend.

Returns: Index of where variable radius data item is created
Created in NX8.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
parameter	Parameter location of point on the edge
radius	The radius at this point on the edge.
centerValue	The conic center value at this point on the edge.
rhoValue	The conic rho value at this point on the edge.
smartPoint	Smart Point defining the location of this vr
isExternal	Flag indicating whether this point is external to blend
isArclength	Flag indicating whether parameter is arclength or not

int NXOpen::Features::EdgeBlendBuilder::AddVariableRadiusData	(	NXOpen::Edge *	edge,
		double	parameter,
		const NXString &	radius,
		NXOpen::Point *	smartPoint,
		bool	isExternal
	)

Add an edge blend variable radius data for an edge in the edge blend.

Returns: Index of where variable radius data item is created

Deprecated:: Deprecated in NX6.0.0. Use Features::EdgeBlendBuilder::AddVariableRadiusDataNew instead.

Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
parameter	Parameter location of point on the edge
radius	The radius at this point on the edge.
smartPoint	Smart Point defining the location of this vr
isExternal	Flag indicating whether this point is external to blend

int NXOpen::Features::EdgeBlendBuilder::AddVariableRadiusData	(	NXOpen::Edge *	edge,
		double	parameter,
		const char *	radius,
		NXOpen::Point *	smartPoint,
		bool	isExternal
	)

Add an edge blend variable radius data for an edge in the edge blend.

Returns: Index of where variable radius data item is created

Deprecated:: Deprecated in NX6.0.0. Use Features::EdgeBlendBuilder::AddVariableRadiusDataNew instead.

Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
parameter	Parameter location of point on the edge
radius	The radius at this point on the edge.
smartPoint	Smart Point defining the location of this vr
isExternal	Flag indicating whether this point is external to blend

int NXOpen::Features::EdgeBlendBuilder::AddVariableRadiusDataNew	(	NXOpen::Edge *	edge,
		const NXString &	parameter,
		const NXString &	radius,
		NXOpen::Point *	smartPoint,
		bool	isExternal
	)

Add an edge blend variable radius data for an edge in the edge blend Note: This ja will always create arclength parameter.

Returns: Index of where variable radius data item is created
Created in NX6.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
parameter	Parameter location of point on the edge
radius	The radius at this point on the edge.
smartPoint	Smart Point defining the location of this vr
isExternal	Flag indicating whether this point is external to blend

int NXOpen::Features::EdgeBlendBuilder::AddVariableRadiusDataNew	(	NXOpen::Edge *	edge,
		const char *	parameter,
		const char *	radius,
		NXOpen::Point *	smartPoint,
		bool	isExternal
	)

Add an edge blend variable radius data for an edge in the edge blend Note: This ja will always create arclength parameter.

Returns: Index of where variable radius data item is created
Created in NX6.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
parameter	Parameter location of point on the edge
radius	The radius at this point on the edge.
smartPoint	Smart Point defining the location of this vr
isExternal	Flag indicating whether this point is external to blend

int NXOpen::Features::EdgeBlendBuilder::AddVariableRadiusDataNew	(	NXOpen::Edge *	edge,
		const NXString &	parameter,
		const NXString &	radius,
		NXOpen::Point *	smartPoint,
		bool	isExternal,
		bool	isArclength
	)

Add an edge blend variable radius data for an edge in the edge blend.

Returns: Index of where variable radius data item is created
Created in NX6.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
parameter	Parameter location of point on the edge
radius	The radius at this point on the edge.
smartPoint	Smart Point defining the location of this vr
isExternal	Flag indicating whether this point is external to blend
isArclength	Flag indicating whether parameter is arclength or not

int NXOpen::Features::EdgeBlendBuilder::AddVariableRadiusDataNew	(	NXOpen::Edge *	edge,
		const char *	parameter,
		const char *	radius,
		NXOpen::Point *	smartPoint,
		bool	isExternal,
		bool	isArclength
	)

Add an edge blend variable radius data for an edge in the edge blend.

Returns: Index of where variable radius data item is created
Created in NX6.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
parameter	Parameter location of point on the edge
radius	The radius at this point on the edge.
smartPoint	Smart Point defining the location of this vr
isExternal	Flag indicating whether this point is external to blend
isArclength	Flag indicating whether parameter is arclength or not

bool NXOpen::Features::EdgeBlendBuilder::AllInstancesOption ( )

Returns the blend all instances option.

Created in NX4.0.0.

License requirements : None

NXOpen::Features::EdgeBlendBuilder::FaceContinuity NXOpen::Features::EdgeBlendBuilder::BlendFaceContinuity ( )

Returns the Blend Face Continuity option
Created in NX10.0.0.

License requirements : None

NXOpen::Features::EdgeBlendBuilder::OrderOfBlending NXOpen::Features::EdgeBlendBuilder::BlendOrder ( )

Returns the order of blending for edge blend
Created in NX4.0.0.

License requirements : None

NXOpen::ScCollector* NXOpen::Features::EdgeBlendBuilder::CliffEdges ( )

Returns the forced cliff edges for edge blend
Created in NX5.0.0.

License requirements : None

bool NXOpen::Features::EdgeBlendBuilder::ConvexConcaveY ( )

Returns the Special blend at convex / concave Y option.

Created in NX4.0.0.

License requirements : None

void NXOpen::Features::EdgeBlendBuilder::EditVariablePointData	(	NXOpen::Edge *	edge,
		int	vrIndex,
		const NXString &	parameter,
		const NXString &	radius,
		const NXString &	centerValue,
		const NXString &	rhoValue,
		NXOpen::Point *	smartPoint,
		bool	isExternal,
		bool	isArclength
	)

Edit an edge blend variable radius data for an edge in the edge blend
Created in NX8.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
vrIndex	Index of what variable radius data item to edit
parameter	Parameter location of point on the edge
radius	The radius at this point on the edge.
centerValue	The conic center value at this point on the edge.
rhoValue	The conic center value at this point on the edge.
smartPoint	Smart Point defining the location of this vr
isExternal	Flag indicating whether this point is external to blend
isArclength	Flag indicating whether the parameter is arclength or not

void NXOpen::Features::EdgeBlendBuilder::EditVariablePointData	(	NXOpen::Edge *	edge,
		int	vrIndex,
		const char *	parameter,
		const char *	radius,
		const char *	centerValue,
		const char *	rhoValue,
		NXOpen::Point *	smartPoint,
		bool	isExternal,
		bool	isArclength
	)

Edit an edge blend variable radius data for an edge in the edge blend
Created in NX8.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
vrIndex	Index of what variable radius data item to edit
parameter	Parameter location of point on the edge
radius	The radius at this point on the edge.
centerValue	The conic center value at this point on the edge.
rhoValue	The conic center value at this point on the edge.
smartPoint	Smart Point defining the location of this vr
isExternal	Flag indicating whether this point is external to blend
isArclength	Flag indicating whether the parameter is arclength or not

void NXOpen::Features::EdgeBlendBuilder::EditVariableRadiusData	(	NXOpen::Edge *	edge,
		int	vrIndex,
		double	parameter,
		const NXString &	radius,
		NXOpen::Point *	smartPoint,
		bool	isExternal
	)

Edit an edge blend variable radius data for an edge in the edge blend

Deprecated:: Deprecated in NX6.0.0.

Use Features::EdgeBlendBuilder::EditVariableRadiusDataNew instead.

Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
vrIndex	Index of what variable radius data item to edit
parameter	Parameter location of point on the edge
radius	The radius at this point on the edge.
smartPoint	Smart Point defining the location of this vr
isExternal	Flag indicating whether this point is external to blend

void NXOpen::Features::EdgeBlendBuilder::EditVariableRadiusData	(	NXOpen::Edge *	edge,
		int	vrIndex,
		double	parameter,
		const char *	radius,
		NXOpen::Point *	smartPoint,
		bool	isExternal
	)

Edit an edge blend variable radius data for an edge in the edge blend

Deprecated:: Deprecated in NX6.0.0.

Use Features::EdgeBlendBuilder::EditVariableRadiusDataNew instead.

Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
vrIndex	Index of what variable radius data item to edit
parameter	Parameter location of point on the edge
radius	The radius at this point on the edge.
smartPoint	Smart Point defining the location of this vr
isExternal	Flag indicating whether this point is external to blend

void NXOpen::Features::EdgeBlendBuilder::EditVariableRadiusDataNew	(	NXOpen::Edge *	edge,
		int	vrIndex,
		const NXString &	parameter,
		const NXString &	radius,
		NXOpen::Point *	smartPoint,
		bool	isExternal
	)

Edit an edge blend variable radius data for an edge in the edge blend
Created in NX6.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
vrIndex	Index of what variable radius data item to edit
parameter	Parameter location of point on the edge
radius	The radius at this point on the edge.
smartPoint	Smart Point defining the location of this vr
isExternal	Flag indicating whether this point is external to blend

void NXOpen::Features::EdgeBlendBuilder::EditVariableRadiusDataNew	(	NXOpen::Edge *	edge,
		int	vrIndex,
		const char *	parameter,
		const char *	radius,
		NXOpen::Point *	smartPoint,
		bool	isExternal
	)

Edit an edge blend variable radius data for an edge in the edge blend
Created in NX6.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
vrIndex	Index of what variable radius data item to edit
parameter	Parameter location of point on the edge
radius	The radius at this point on the edge.
smartPoint	Smart Point defining the location of this vr
isExternal	Flag indicating whether this point is external to blend

void NXOpen::Features::EdgeBlendBuilder::EditVariableRadiusDataNew	(	NXOpen::Edge *	edge,
		int	vrIndex,
		const NXString &	parameter,
		const NXString &	radius,
		NXOpen::Point *	smartPoint,
		bool	isExternal,
		bool	isArclength
	)

Edit an edge blend variable radius data for an edge in the edge blend
Created in NX6.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
vrIndex	Index of what variable radius data item to edit
parameter	Parameter location of point on the edge
radius	The radius at this point on the edge.
smartPoint	Smart Point defining the location of this vr
isExternal	Flag indicating whether this point is external to blend
isArclength	Flag indicating whether the parameter is arclength or not

void NXOpen::Features::EdgeBlendBuilder::EditVariableRadiusDataNew	(	NXOpen::Edge *	edge,
		int	vrIndex,
		const char *	parameter,
		const char *	radius,
		NXOpen::Point *	smartPoint,
		bool	isExternal,
		bool	isArclength
	)

Edit an edge blend variable radius data for an edge in the edge blend
Created in NX6.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
vrIndex	Index of what variable radius data item to edit
parameter	Parameter location of point on the edge
radius	The radius at this point on the edge.
smartPoint	Smart Point defining the location of this vr
isExternal	Flag indicating whether this point is external to blend
isArclength	Flag indicating whether the parameter is arclength or not

void NXOpen::Features::EdgeBlendBuilder::GetChainset	(	int	csIndex,
		NXOpen::ScCollector **	collector,
		NXOpen::Expression **	radius
	)

Get collector and radius for an edge blend chainset given the index of the chainset
Created in NX4.0.0.

License requirements : None

Parameters

csIndex	Index of chainset, indicating which chainset we are dealing with
collector	The collector for this edge blend chainset
radius	The radius of this chain set collector

void NXOpen::Features::EdgeBlendBuilder::GetChainsetAndSectionValue	(	int	csIndex,
		NXOpen::ScCollector **	collector,
		NXOpen::Features::EdgeBlendBuilder::Section *	sectionType,
		NXOpen::Features::EdgeBlendBuilder::Conic *	conicMethod,
		NXOpen::Features::EdgeBlendBuilder::Rhotype *	rhoType,
		NXOpen::Expression **	radius,
		NXOpen::Expression **	centerValueTAG,
		NXOpen::Expression **	rhoValueTAG
	)

Get collector, radius and section types for an edge blend chainset given the index of the chainset
Created in NX10.0.3.

License requirements : None

Parameters

csIndex	Index of chainset
collector	The collector for this edge blend chainset
sectionType	The section type of this chain set collector
conicMethod	The conic method of this chain set collector
rhoType	The rho type of this chain set collector
radius	The radius of this chain set collector
centerValueTAG	The conic center value expression of this chain set collector
rhoValueTAG	The conic rho value expression of this chain set collector

void NXOpen::Features::EdgeBlendBuilder::GetChainsetAndStatus	(	int	csIndex,
		NXOpen::ScCollector **	collector,
		NXOpen::Expression **	radius,
		bool *	isValid
	)

Get collector, radius and validity status for an edge blend chainset given the index of the chainset
Created in NX5.0.0.

License requirements : None

Parameters

csIndex	Index of chainset
collector	The collector for this edge blend chainset
radius	The radius of this chain set collector
isValid	Is the chainset alive/valid ?

int NXOpen::Features::EdgeBlendBuilder::GetChainsetIndex ( NXOpen::ScCollector * collector )

Get the index of edge blend chainset given the collector.

Returns: Index of chainset, indicating which chainset we are dealing with
Created in NX4.0.0.

License requirements : None

Parameters

collector The collector for this edge blend chainset

NXOpen::GeometricUtilities::BlendStopshortBuilder* NXOpen::Features::EdgeBlendBuilder::GetNewStopshortData ( int ssIndex )

Get an edge blend stop short data for the index provided.

Returns: the Stopshort Data
Created in NX5.0.0.

License requirements : None

Parameters

ssIndex Index of where stop short data item is created

int NXOpen::Features::EdgeBlendBuilder::GetNumberOfValidChainsets ( )

Get the number of valid chainsets.

Returns: Number of valid chainsets
Created in NX5.0.0.

License requirements : None

std::vector<NXOpen::Edge *> NXOpen::Features::EdgeBlendBuilder::GetSetbackData	(	int	sbIndex,
		std::vector< bool > &	fromStart,
		std::vector< NXOpen::Expression * > &	distanceExp
	)

Get an edge blend setback data for the index provided.

Returns: Array of Edge collector tags that are used by the setback
Created in NX4.0.0.

License requirements : None

Parameters

sbIndex	Index of where setback data item was created.
fromStart	if true, then the setback is defined at the start vertex. Otherwise, it is defined at the end vertex. There is one for each output edge.
distanceExp	The distance for the setback on each edge.

NXOpen::Expression* NXOpen::Features::EdgeBlendBuilder::GetStopshortData	(	int	ssIndex,
		NXOpen::Edge **	edge,
		bool *	fromStart
	)

Get an edge blend stop short data for the index provided.

Returns: The distance for the stopshort on the edge.

Deprecated:: Deprecated in NX5.0.0. Use Features::EdgeBlendBuilder::GetNewStopshortData instead.

Created in NX4.0.0.

License requirements : None

Parameters

ssIndex	Index of where stop short data item is created.
edge	Edge the stop short data is on.
fromStart	if true, then the stopshort is defined at the start vertex. Otherwise, it is defined at the end vertex.

std::vector<double> NXOpen::Features::EdgeBlendBuilder::GetVariableRadiusData	(	NXOpen::Edge *	edge,
		std::vector< NXOpen::Expression * > &	radiiExp,
		std::vector< NXOpen::Point * > &	smartPoints,
		std::vector< bool > &	isExternalFlagArray
	)

Get all the variable radii data for an edge in the edge blend.

Returns: Parameter locations of points on the edge

Deprecated:: Deprecated in NX6.0.0. Use Features::EdgeBlendBuilder::GetVariableRadiusDataNew instead.

Created in NX4.0.0.

License requirements : None

Parameters

edge	Edge to get all the varible radius data on
radiiExp	The radius value of each point on the edge
smartPoints	Array of smart points defining variable radius
isExternalFlagArray	Corresponding is_external flags of the variable radius points

void NXOpen::Features::EdgeBlendBuilder::GetVariableRadiusDataNew	(	NXOpen::Edge *	edge,
		std::vector< NXOpen::Expression * > &	parameterExp,
		std::vector< NXOpen::Expression * > &	radiiExp,
		std::vector< NXOpen::Point * > &	smartPoints,
		std::vector< bool > &	isExternalFlagArray
	)

Get all the variable radii data for an edge in the edge blend
Created in NX6.0.0.

License requirements : None

Parameters

edge	Edge to get all the varible radius data on
parameterExp	Parameter value of points on the edge
radiiExp	The radius value of each point on the edge
smartPoints	Array of smart points defining variable radius
isExternalFlagArray	Corresponding is_external flags of the variable radius points

bool NXOpen::Features::EdgeBlendBuilder::LimitFailingAreas ( )

Returns the Limit Failing Areas option.

Created in NX8.5.0.

License requirements : None

NXOpen::GeometricUtilities::BlendLimitsData* NXOpen::Features::EdgeBlendBuilder::LimitsListData ( )

Returns the limits list
Created in NX5.0.0.

License requirements : None

bool NXOpen::Features::EdgeBlendBuilder::MoveSharpEdge ( )

Returns the Maintain blend and move sharp edges option.

Created in NX4.0.0.

License requirements : None

NXOpen::ScCollector* NXOpen::Features::EdgeBlendBuilder::NonCliffEdges ( )

Returns the prohibited cliff edges for edge blend
Created in NX5.0.0.

License requirements : None

NXOpen::Features::EdgeBlendBuilder::Overlap NXOpen::Features::EdgeBlendBuilder::OverlapOption ( )

Returns the overlap resolution for edge blend
Created in NX4.0.0.

License requirements : None

bool NXOpen::Features::EdgeBlendBuilder::PatchComplexGeometryAreas ( )

Returns the Patch Areas option.

Created in NX8.5.0.

License requirements : None

void NXOpen::Features::EdgeBlendBuilder::RemoveChainset ( int csIndex )

Delete an edge blend chainset from the edge blend.

Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

csIndex Index of chainset, indicating which chainset we are dealing with

void NXOpen::Features::EdgeBlendBuilder::RemoveChainsetByCollector ( NXOpen::ScCollector * collector )

Delete an edge blend chainset from the edge blend.

Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

collector The collector for this edge blend chainset

void NXOpen::Features::EdgeBlendBuilder::RemoveEdgeChainAndPointOnEdgeChainData ( )

Remove all existing edge chain data and point on edge chain data
Created in NX11.0.1.

License requirements : solid_modeling ("SOLIDS MODELING")

void NXOpen::Features::EdgeBlendBuilder::RemoveNewStopshortData ( NXOpen::GeometricUtilities::BlendStopshortBuilder * builder )

Remove an edge blend stop short corresponding to a BlendStopshortBuilder
Created in NX5.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

builder the Stopshort Data

bool NXOpen::Features::EdgeBlendBuilder::RemoveSelfIntersection ( )

Returns the Remove self-intersection option.

Created in NX4.0.0.

License requirements : None

void NXOpen::Features::EdgeBlendBuilder::RemoveSetbackData ( int sbIndex )

Remove an edge blend setback data for an edge in the edge blend
Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

sbIndex Index of where setback data item was created

void NXOpen::Features::EdgeBlendBuilder::RemoveStopshortData	(	NXOpen::Edge *	edge,
		bool	fromStart
	)

Remove an edge blend stop short data for an edge

Deprecated:: Deprecated in NX5.0.0.

Use Features::EdgeBlendBuilder::RemoveNewStopshortData instead.

Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to remove the stopshort on
fromStart	if true, then the stopshort is defined at the start vertex. Otherwise, it is defined at the end vertex.

void NXOpen::Features::EdgeBlendBuilder::RemoveStopshortData ( int ssIndex )

Remove an edge blend stop short data for the index indicated

Deprecated:: Deprecated in NX5.0.0.

Use Features::EdgeBlendBuilder::RemoveNewStopshortData instead.

Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

ssIndex Index of where stop short data item is created.

void NXOpen::Features::EdgeBlendBuilder::RemoveStopshortDataByType	(	NXOpen::Edge *	edge,
		bool	fromStart,
		NXOpen::GeometricUtilities::BlendStopshortBuilder::Choices	type
	)

Remove the stop short from an edge, given its type and location
Created in NX5.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to remove the stopshort on
fromStart	if true, then the stopshort is defined at the start vertex. Otherwise, it is defined at the end vertex.
type	the type of the stopshort

void NXOpen::Features::EdgeBlendBuilder::RemoveVariableRadiusData	(	NXOpen::Edge *	edge,
		double	parameter
	)

Remove variable radius data on an edge by the parameter value of the point on the edge
Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to add stop short data on
parameter	Parameter location of point on the edge

void NXOpen::Features::EdgeBlendBuilder::RemoveVariableRadiusData ( NXOpen::Edge * edge )

Remove all variable radius datas on an edge
Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to remove all variable radius datas from

void NXOpen::Features::EdgeBlendBuilder::RemoveVariableRadiusDataByIndex	(	NXOpen::Edge *	edge,
		int	index
	)

Remove variable radius data on an edge by the index into the point array on the edge
Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

edge	Edge to remove variable radius data on
index	Index into point array on the edge

bool NXOpen::Features::EdgeBlendBuilder::RollOntoEdge ( )

Returns the Roll onto edges option.

Created in NX4.0.0.

License requirements : None

bool NXOpen::Features::EdgeBlendBuilder::RollOverSmoothEdge ( )

Returns the Roll over smooth edges option.

Created in NX4.0.0.

License requirements : None

bool NXOpen::Features::EdgeBlendBuilder::SegmentBlendFaces ( )

Returns the Segment blend to match face segments option
Created in NX10.0.0.

License requirements : None

void NXOpen::Features::EdgeBlendBuilder::SetAllInstancesOption ( bool optionValue )

Sets the blend all instances option.

Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

optionValue option value

NXOpen::Features::EdgeBlendBuilder::Setback NXOpen::Features::EdgeBlendBuilder::SetbackOption ( )

Returns the setback option for edge blend
Created in NX4.0.0.

License requirements : None

void NXOpen::Features::EdgeBlendBuilder::SetBlendFaceContinuity ( NXOpen::Features::EdgeBlendBuilder::FaceContinuity optionValue )

Sets the Blend Face Continuity option
Created in NX10.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

optionValue optionvalue

void NXOpen::Features::EdgeBlendBuilder::SetBlendOrder ( NXOpen::Features::EdgeBlendBuilder::OrderOfBlending blendOrder )

Sets the order of blending for edge blend
Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

blendOrder blend order

void NXOpen::Features::EdgeBlendBuilder::SetCliffEdges ( NXOpen::ScCollector * cliffEdgeCollector )

Sets the forced cliff edges for edge blend
Created in NX5.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

cliffEdgeCollector The cliff edge collector

void NXOpen::Features::EdgeBlendBuilder::SetConvexConcaveY ( bool optionValue )

Sets the Special blend at convex / concave Y option.

Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

optionValue option value

void NXOpen::Features::EdgeBlendBuilder::SetLimitFailingAreas ( bool optionValue )

Sets the Limit Failing Areas option.

Created in NX8.5.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

optionValue option value

void NXOpen::Features::EdgeBlendBuilder::SetMoveSharpEdge ( bool optionValue )

Sets the Maintain blend and move sharp edges option.

Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

optionValue option value

void NXOpen::Features::EdgeBlendBuilder::SetNonCliffEdges ( NXOpen::ScCollector * nonCliffEdgeCollector )

Sets the prohibited cliff edges for edge blend
Created in NX5.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

nonCliffEdgeCollector The non cliff edge collector

void NXOpen::Features::EdgeBlendBuilder::SetOverlapOption ( NXOpen::Features::EdgeBlendBuilder::Overlap overlapOption )

Sets the overlap resolution for edge blend
Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

overlapOption overlap option

void NXOpen::Features::EdgeBlendBuilder::SetPatchComplexGeometryAreas ( bool optionValue )

Sets the Patch Areas option.

Created in NX8.5.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

optionValue option value

void NXOpen::Features::EdgeBlendBuilder::SetRemoveSelfIntersection ( bool optionValue )

Sets the Remove self-intersection option.

Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

optionValue option value

void NXOpen::Features::EdgeBlendBuilder::SetRollOntoEdge ( bool optionValue )

Sets the Roll onto edges option.

Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

optionValue option value

void NXOpen::Features::EdgeBlendBuilder::SetRollOverSmoothEdge ( bool optionValue )

Sets the Roll over smooth edges option.

Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

optionValue option value

void NXOpen::Features::EdgeBlendBuilder::SetSegmentBlendFaces ( bool optionValue )

Sets the Segment blend to match face segments option
Created in NX10.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

optionValue optionvalue

void NXOpen::Features::EdgeBlendBuilder::SetSetbackOption ( NXOpen::Features::EdgeBlendBuilder::Setback setbackOption )

Sets the setback option for edge blend
Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

setbackOption setback option

void NXOpen::Features::EdgeBlendBuilder::SetTolerance ( double tolerance )

Sets the tolerance of a variable blend.

Created in NX4.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

tolerance tolerance

void NXOpen::Features::EdgeBlendBuilder::SetTrimmingOption ( bool optionValue )

Sets the trimming option.

Created in NX5.0.0.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

optionValue option value

void NXOpen::Features::EdgeBlendBuilder::SetZeroSlopeRadiusFunctionAtChainEnds ( bool optionValue )

Sets the zero slope radius function at chain ends option
Created in NX10.0.1.

License requirements : solid_modeling ("SOLIDS MODELING")

Parameters

optionValue optionvalue

double NXOpen::Features::EdgeBlendBuilder::Tolerance ( )

Returns the tolerance of a variable blend.

Created in NX4.0.0.

License requirements : None

bool NXOpen::Features::EdgeBlendBuilder::TrimmingOption ( )

Returns the trimming option.

Created in NX5.0.0.

License requirements : None

bool NXOpen::Features::EdgeBlendBuilder::ZeroSlopeRadiusFunctionAtChainEnds ( )

Returns the zero slope radius function at chain ends option
Created in NX10.0.1.

License requirements : None

The documentation for this class was generated from the following file:

Features_EdgeBlendBuilder.hxx

Public Types

Public Member Functions

Detailed Description

Member Enumeration Documentation

Member Function Documentation