Constraint Class¶
-
class
NXOpen.Positioning.
Constraint
¶ Bases:
NXOpen.NXObject
Constraint for use in positioning objects in NX.
For constraints between components, the subclass
NXOpen.Positioning.ComponentConstraint
should be used by preference.To create a new instance of this class, use
NXOpen.Positioning.Positioner.CreateConstraint
New in version NX4.0.0.
Properties¶
Property | Description |
---|---|
Automatic | Returns or sets the flag marking the constraint as an automatic constraint. |
ConstraintAlignment | Returns or sets the alignment behavior for the constraint. |
ConstraintType | Returns or sets the constraint type. |
Expression | Returns the expression used for constraint. |
IsOccurrence | Returns whether this object is an occurrence or not. |
JournalIdentifier | Returns the identifier that would be recorded in a journal for this object. |
Name | Returns the custom name of the object. |
OwningComponent | Returns the owning component, if this object is an occurrence. |
OwningPart | Returns the owning part of this object |
Persistent | Returns or sets the persistent state of the constraint. |
Prototype | Returns the prototype of this object if it is an occurrence. |
SplinePointsType | Returns or sets the type of the spline. |
Suppressed | Returns or sets the suppression state for the constraint. |
Tag | Returns the Tag for this object. |
Methods¶
Method | Description |
---|---|
CreateConstraintReference | Adds geometry to a constraint and sets the movable object to be constrained. |
DeleteAllAttributesByType | Deletes all attributes of a specific type. |
DeleteAttributeByTypeAndTitle | Deletes an attribute by type and title. |
DeleteConstraintReference | Removes a NXOpen.Positioning.ConstraintReference from the constraint. |
DeleteUserAttribute | Deletes the first attribute encountered with the given Type, Title. |
DeleteUserAttributes | Deletes the attributes encountered with the given Type with option to update or not. |
EditConstraintReference | Adds geometry to a constraint and sets the movable object to be constrained, replacing the properties of an existing reference of the constraint. |
FindObject | Finds the NXOpen.NXObject with the given identifier as recorded in a journal. |
FlipAlignment | Reverses the constraint alignment if this is possible. |
GenerateConversionReport | Returns a textual conversion report this constraint from when it was converted from a Mating Constraint to an Assembly Constraint. |
GetAttributeTitlesByType | Gets all the attribute titles of a specific type. |
GetBooleanUserAttribute | Gets a boolean attribute by Title and array Index. |
GetComputationalTimeUserAttribute | Gets a time attribute by Title and array Index. |
GetConstraintStatus | Returns the solver status of a constraint. |
GetDisplayedConstraint | Gets the NXOpen.Positioning.DisplayedConstraint that is in the same part as that of the constraint. |
GetIntegerAttribute | Gets an integer attribute by title. |
GetIntegerUserAttribute | Gets an integer attribute by Title and array Index. |
GetRealAttribute | Gets a real attribute by title. |
GetRealUserAttribute | Gets a real attribute by Title and array Index. |
GetReferenceAttribute | Gets the reference string (not the calculated value) of a string attribute that uses a reference string. |
GetReferences | Gets all the :py:class:`NXOpen.Positioning.ConstraintReference`s for the constraint. |
GetStringAttribute | Gets a string attribute value by title. |
GetStringUserAttribute | Gets a string attribute by Title and array Index. |
GetTimeAttribute | Gets a time attribute by title. |
GetTimeUserAttribute | Gets a time attribute by Title and array Index. |
GetUserAttribute | Gets the first attribute encountered on the object, if any, with a given Title, Type and array Index. |
GetUserAttributeAsString | Gets the first attribute encountered on the object, if any, with a given title, type and array index. |
GetUserAttributeCount | Gets the count of set attributes on the object, if any, of the given type. |
GetUserAttributeLock | Determine the lock of the given attribute. |
GetUserAttributeSize | Gets the size of the first attribute encountered on the object, if any, with a given Title and Type. |
GetUserAttributeSourceObjects | Returns an array of objects from which this object presents attributes. |
GetUserAttributes | Gets all the attributes that have been set on the given object. |
GetUserAttributesAsStrings | Gets all the attributes that have been set on the given object. |
HasUserAttribute | Determines if an attribute with the given Title, Type and array Index is present on the object Unset attributes will not be detected by this function, as its purpose is to test for the actual presence of the attribute on the object. |
Prints a representation of this object to the system log file. | |
ReverseDirection | Reverses the constraint direction. |
SetAlignmentHint | Set a hint as to which alignment should be used by the solver for this constraint. |
SetAttribute | Creates or modifies an integer attribute. |
SetBooleanUserAttribute | Creates or modifies a boolean attribute with the option to update or not. |
SetExpression | The expression used for constraint - only for distance or angle |
SetName | Sets the custom name of the object. |
SetReferenceAttribute | Creates or modifies a string attribute which uses a reference string. |
SetTimeAttribute | Creates or modifies a time attribute. |
SetTimeUserAttribute | Creates or modifies a time attribute with the option to update or not. |
SetUserAttribute | Creates or modifies an attribute with the option to update or not. |
SetUserAttributeLock | Lock or unlock the given attribute. |
Enumerations¶
ConstraintAlignment Enumeration | Specifies alignment of directed geometries used in a constraint. |
ConstraintSolverStatus Enumeration | Specifies the status of a constraint. |
ConstraintSplineType Enumeration | Specifies how the spline points define the shape of the spline. |
ConstraintType Enumeration | Specifies the type of a constraint. |
Property Detail¶
Automatic¶
-
Constraint.
Automatic
¶ Returns or sets the flag marking the constraint as an “automatic” constraint.
Automatic constraints are constraints created by the system, but are visible and editable by the user. Automatic constraints are automatically deleted when one of the referenced objects are deleted by update.
-------------------------------------
Getter Method
Signature
Automatic()
Returns: The automatic state Return type: bool New in version NX5.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
-------------------------------------
Setter Method
Signature
Automatic(isauto)
Parameters: isauto (bool) – The automatic state New in version NX5.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
ConstraintAlignment¶
-
Constraint.
ConstraintAlignment
¶ Returns or sets the alignment behavior for the constraint.
-------------------------------------
Getter Method
Signature
ConstraintAlignment()
Returns: Alignment behavior for constraint Return type: NXOpen.Positioning.ConstraintAlignment
New in version NX4.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
-------------------------------------
Setter Method
Signature
ConstraintAlignment(alignment)
Parameters: alignment ( NXOpen.Positioning.ConstraintAlignment
) – Alignment behavior for constraintNew in version NX4.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
ConstraintType¶
-
Constraint.
ConstraintType
¶ Returns or sets the constraint type.
-------------------------------------
Getter Method
Signature
ConstraintType()
Returns: Return type: NXOpen.Positioning.ConstraintType
New in version NX4.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
-------------------------------------
Setter Method
Signature
ConstraintType(constraintType)
Parameters: constraintType ( NXOpen.Positioning.ConstraintType
) –New in version NX4.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
Expression¶
-
Constraint.
Expression
¶ Returns the expression used for constraint.
The expression will be unused unless this constraint has type distance or angle.
-------------------------------------
Getter Method
Signature
Expression()
Returns: Expression used in distance or angle constraint Return type: NXOpen.Expression
New in version NX4.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
IsOccurrence¶
-
Constraint.
IsOccurrence
¶ Returns whether this object is an occurrence or not.
-------------------------------------
Getter Method
Signature
IsOccurrence()
Returns: This object is an occurrence Return type: bool New in version NX3.0.0.
License requirements: None.
JournalIdentifier¶
-
Constraint.
JournalIdentifier
¶ Returns the identifier that would be recorded in a journal for this object.
This may not be the same across different releases of the software.
-------------------------------------
Getter Method
Signature
JournalIdentifier()
Returns: Return type: str New in version NX3.0.0.
License requirements: None.
Name¶
-
Constraint.
Name
¶ Returns the custom name of the object.
-------------------------------------
Getter Method
Signature
Name()
Returns: Return type: str New in version NX3.0.0.
License requirements: None.
OwningComponent¶
-
Constraint.
OwningComponent
¶ Returns the owning component, if this object is an occurrence.
-------------------------------------
Getter Method
Signature
OwningComponent()
Returns: Return type: NXOpen.Assemblies.Component
New in version NX3.0.0.
License requirements: None.
OwningPart¶
-
Constraint.
OwningPart
¶ Returns the owning part of this object
-------------------------------------
Getter Method
Signature
OwningPart()
Returns: The owning part of this object or null if it does not have an owner Return type: NXOpen.BasePart
New in version NX3.0.0.
License requirements: None.
Persistent¶
-
Constraint.
Persistent
¶ Returns or sets the persistent state of the constraint.
-------------------------------------
Getter Method
Signature
Persistent()
Returns: The persistent state Return type: bool New in version NX4.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
-------------------------------------
Setter Method
Signature
Persistent(persistent)
Parameters: persistent (bool) – The persistent state New in version NX4.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
Prototype¶
-
Constraint.
Prototype
¶ Returns the prototype of this object if it is an occurrence.
-------------------------------------
Getter Method
Signature
Prototype()
Returns: The prototype of this object or null if this object is not an occurrence Return type: NXOpen.INXObject
New in version NX3.0.0.
License requirements: None.
SplinePointsType¶
-
Constraint.
SplinePointsType
¶ Returns or sets the type of the spline.
Only valid if the type of the constraint is set to
NXOpen.Positioning.ConstraintType.SplineData
.-------------------------------------
Getter Method
Signature
SplinePointsType()
Returns: Return type: NXOpen.Positioning.ConstraintSplineType
New in version NX6.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
-------------------------------------
Setter Method
Signature
SplinePointsType(splineType)
Parameters: splineType ( NXOpen.Positioning.ConstraintSplineType
) –New in version NX6.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
Suppressed¶
-
Constraint.
Suppressed
¶ Returns or sets the suppression state for the constraint.
In a
NXOpen.Positioning.ComponentConstraint
this is the state in theNXOpen.Positioning.ComponentPositioner.PrimaryArrangement`
.”-------------------------------------
Getter Method
Signature
Suppressed()
Returns: The suppression state Return type: bool New in version NX4.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
-------------------------------------
Setter Method
Signature
Suppressed(suppressed)
Parameters: suppressed (bool) – The suppression state New in version NX4.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
Method Detail¶
CreateConstraintReference¶
-
Constraint.
CreateConstraintReference
¶ Overloaded method CreateConstraintReference
CreateConstraintReference(movableObject, geometry, usesAxis, isIndirect)
CreateConstraintReference(movableObject, geometry, usesAxis, isIndirect, usePortRotate)
-------------------------------------
Adds geometry to a constraint and sets the movable object to be constrained.
Signature
CreateConstraintReference(movableObject, geometry, usesAxis, isIndirect)
Parameters: - movableObject (
NXOpen.NXObject
) – Object to be positioned by constraint - geometry (
NXOpen.NXObject
) – Geometry used to define constraint - usesAxis (bool) – Use axis of geometry
- isIndirect (bool) – Geometry is to be used indirectly to identify geometry in another part
Returns: Return type: New in version NX4.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
-------------------------------------
Adds geometry to a constraint and sets the movable object to be constrained.
Signature
CreateConstraintReference(movableObject, geometry, usesAxis, isIndirect, usePortRotate)
Parameters: - movableObject (
NXOpen.NXObject
) – Object to be positioned by constraint - geometry (
NXOpen.NXObject
) – Geometry used to define constraint - usesAxis (bool) – Use axis of geometry
- isIndirect (bool) – Geometry is to be used indirectly to identify geometry in another part
- usePortRotate (bool) – Use rotate vector of
NXOpen.Routing.Port
.
Returns: Return type: New in version NX4.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
-------------------------------------
DeleteConstraintReference¶
-
Constraint.
DeleteConstraintReference
¶ Removes a
NXOpen.Positioning.ConstraintReference
from the constraint.Signature
DeleteConstraintReference(constraintReference)
Parameters: constraintReference ( NXOpen.Positioning.ConstraintReference
) – The constraint reference to remove. A list of references can be obtained viaNXOpen.Positioning.Constraint.GetReferences
.New in version NX4.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
EditConstraintReference¶
-
Constraint.
EditConstraintReference
¶ Adds geometry to a constraint and sets the movable object to be constrained, replacing the properties of an existing reference of the constraint.
Signature
EditConstraintReference(constraintReference, movableObject, geometry, usesAxis, isIndirect, usePortRotate)
Parameters: - constraintReference (
NXOpen.Positioning.ConstraintReference
) – TheNXOpen.Positioning.ConstraintReference
whose properties are to be changed - movableObject (
NXOpen.NXObject
) – Object to be positioned by constraint - geometry (
NXOpen.NXObject
) – Geometry used to define constraint - usesAxis (bool) – Use axis of geometry
- isIndirect (bool) – Geometry is to be used indirectly to identify geometry in another part
- usePortRotate (bool) – Use rotate vector of
NXOpen.Routing.Port
.
New in version NX5.0.1.
License requirements: assemblies (“ASSEMBLIES MODULE”)
- constraintReference (
FindObject¶
-
Constraint.
FindObject
¶ Finds the
NXOpen.NXObject
with the given identifier as recorded in a journal.An object may not return the same value as its JournalIdentifier in different versions of the software. However newer versions of the software should find the same object when FindObject is passed older versions of its journal identifier. In general, this method should not be used in handwritten code and exists to support record and playback of journals.
An exception will be thrown if no object can be found with the given journal identifier.
Signature
FindObject(journalIdentifier)
Parameters: journalIdentifier (str) – Journal identifier of the object Returns: Return type: NXOpen.INXObject
New in version NX3.0.0.
License requirements: None.
FlipAlignment¶
-
Constraint.
FlipAlignment
¶ Reverses the constraint alignment if this is possible.
Signature
FlipAlignment()
New in version NX4.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
GenerateConversionReport¶
-
Constraint.
GenerateConversionReport
¶ Returns a textual conversion report this constraint from when it was converted from a Mating Constraint to an Assembly Constraint.
If this isn’t a converted constraint or there were no problems converting this constraint, then an empty string is returned.
Signature
GenerateConversionReport()
Returns: The text lines of the conversion report Return type: list of str New in version NX5.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
GetConstraintStatus¶
-
Constraint.
GetConstraintStatus
¶ Returns the solver status of a constraint.
Signature
GetConstraintStatus()
Returns: The solver status of the constraint Return type: NXOpen.Positioning.ConstraintSolverStatus
New in version NX4.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
GetDisplayedConstraint¶
-
Constraint.
GetDisplayedConstraint
¶ Gets the
NXOpen.Positioning.DisplayedConstraint
that is in the same part as that of the constraint.Note that this will be None if the part has not been the displayed part since the constraint was created.
Signature
GetDisplayedConstraint()
Returns: Return type: NXOpen.Positioning.DisplayedConstraint
New in version NX7.5.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
GetReferences¶
-
Constraint.
GetReferences
¶ Gets all the :py:class:`NXOpen.Positioning.ConstraintReference`s for the constraint.
Signature
GetReferences()
Returns: ConstraintReferences used by this constraint Return type: list of NXOpen.Positioning.ConstraintReference
New in version NX4.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
Print¶
-
Constraint.
Print
¶ Prints a representation of this object to the system log file.
Signature
Print()
New in version NX3.0.0.
License requirements: None.
ReverseDirection¶
-
Constraint.
ReverseDirection
¶ Reverses the constraint direction.
This operation reverses the
NXOpen.Positioning.ConstraintReference.Order
on eachNXOpen.Positioning.ConstraintReference
. So “Inside” becomes “Outside”, “Outside” becomes “Inside” and “Unknown” remains as it is.Signature
ReverseDirection()
New in version NX5.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
SetAlignmentHint¶
-
Constraint.
SetAlignmentHint
¶ Set a hint as to which alignment should be used by the solver for this constraint.
If the constraint does not solve using this alignment then the hint will be ignored.
The hint can only have an effect when the alignment of [version_created(“4”)] the constraint, as returned by
NXOpen.Positioning.Constraint.ConstraintAlignment
, isNXOpen.Positioning.ConstraintAlignment.InferAlign
.The hint can only have an effect when the constraint has been explicitly added to a
NXOpen.Positioning.Network
.Passing in
NXOpen.Positioning.ConstraintAlignment.InferAlign
as the alignment argument will have no effect.The hint is forgotten after an update.
Signature
SetAlignmentHint(alignment)
Parameters: alignment ( NXOpen.Positioning.ConstraintAlignment
) – The alignment hintNew in version NX4.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
SetExpression¶
-
Constraint.
SetExpression
¶ The expression used for constraint - only for distance or angle
Signature
SetExpression(expression)
Parameters: expression (str) – Name of expression used in distance or angle constraint NOTE: The full Unicode character set is not supported for this parameter. New in version NX4.0.0.
License requirements: assemblies (“ASSEMBLIES MODULE”)
SetName¶
-
Constraint.
SetName
¶ Sets the custom name of the object.
NOTE: This method should not be used to edit a read-only object such as a Mirrored PMI object. If it is, the changes will be overridden when the part is updated.
Signature
SetName(name)
Parameters: name (str) – New in version NX3.0.0.
License requirements: None.