Feature Class¶
-
class
NXOpen.Features.
Feature
¶ Bases:
NXOpen.NXObject
,NXOpen.IProfile
,NXOpen.IFitTo
Represents a feature on a part
This is an abstract class, and cannot be instantiated.
New in version NX3.0.0.
Properties¶
Property | Description |
---|---|
AlgorithmVersion | Returns the algorithm version of the feature |
ContainerFeature | Returns the container feature for this feature. |
FeatureType | Returns the feature type |
IsContainedFeature | Returns true if the feature is a contained feature. |
IsInternal | Returns true if the feature is internal. |
IsOccurrence | Returns whether this object is an occurrence or not. |
JournalIdentifier | Returns the identifier that would be recorded in a journal for this object. |
Location | Returns the location of the feature |
Name | Returns the custom name of the object. |
OwningComponent | Returns the owning component, if this object is an occurrence. |
OwningPart | Returns the owning part of this object |
Prototype | Returns the prototype of this object if it is an occurrence. |
Suppressed | Returns the suppression status of the feature |
Tag | Returns the Tag for this object. |
Timestamp | Returns the timestamp of the feature |
Methods¶
Method | Description |
---|---|
BreakWaveLink | Break Wave Link Feature |
ChangeBooleanType | Change Boolean Type |
CreateAttributeIterator | Create an attribute iterator |
DeleteAllAttributesByType | Deletes all attributes of a specific type. |
DeleteAttributeByTypeAndTitle | Deletes an attribute by type and title. |
DeleteClueAlerts | Delete all clue alerts from the features |
DeleteHintAlerts | Delete all clue alerts from the features |
DeleteInformationalAlerts | Delete all informational alerts from the features |
DeleteUserAttribute | Deletes the first attribute encountered with the given Type, Title. |
DeleteUserAttributes | Deletes the attributes on the object, if any, that satisfy the given iterator |
DeleteWarningAlerts | Delete all warning alerts from the features |
FindObject | Finds the NXOpen.NXObject with the given identifier as recorded in a journal. |
GetAllChildren | Returns all immediate child features. |
GetAttributeTitlesByType | Gets all the attribute titles of a specific type. |
GetBooleanUserAttribute | Gets a boolean attribute by Title and array Index. |
GetChildren | Returns the immediate child features. |
GetComputationalTimeUserAttribute | Gets a time attribute by Title and array Index. |
GetEntities | Returns the entities created by the feature. |
GetExpressions | Returns the expressions created by the feature. |
GetFeatureClueHintMessages | Returns both clue and hint messages of the feature. |
GetFeatureClueMessages | Returns the feature clue messages. |
GetFeatureColor | The feature color |
GetFeatureErrorMessages | Returns the feature error messages. |
GetFeatureHintMessages | Returns the feature hint messages. |
GetFeatureInformationalMessages | Returns the feature informational messages. |
GetFeatureName | Returns the displayed name of the feature. |
GetFeatureWarningMessages | Returns the feature warning messages. |
GetIntegerAttribute | Gets an integer attribute by title. |
GetIntegerUserAttribute | Gets an integer attribute by Title and array Index. |
GetNextUserAttribute | Gets the next attribute encountered on the object, if any, that satisfies the given iterator. |
GetParents | Returns the immediate parent features. |
GetPdmReferenceAttributeValue | Gets the value of PDM Reference attribute for given object. |
GetRealAttribute | Gets a real attribute by title. |
GetRealUserAttribute | Gets a real attribute by Title and array Index. |
GetReferenceAttribute | Gets the reference string (not the calculated value) of a string attribute that uses a reference string. |
GetSections | Queries a feature for list of its sections. |
GetStringAttribute | Gets a string attribute value by title. |
GetStringUserAttribute | Gets a string attribute by Title and array Index. |
GetTimeAttribute | Gets a time attribute by title. |
GetTimeUserAttribute | Gets a time attribute by Title and array Index. |
GetUserAttribute | Gets the first attribute encountered on the object, if any, with a given Title, Type and array Index. |
GetUserAttributeAsString | Gets the first attribute encountered on the object, if any, with a given title, type and array index. |
GetUserAttributeCount | Gets the count of set attributes on the object, if any, that satisfy the given iterator. |
GetUserAttributeLock | Determine the lock of the given attribute. |
GetUserAttributeSize | Gets the size of the first attribute encountered on the object, if any, with a given Title and Type. |
GetUserAttributeSourceObjects | Returns an array of objects from which this object presents attributes. |
GetUserAttributes | Gets all the attributes that have been set on the given object, if any, that satisfy the given iterator. |
GetUserAttributesAsStrings | Gets all the attributes that have been set on the given object. |
HasUserAttribute | Determines if an attribute exists on the object, that satisfies the given iterator |
HideBody | Hide the body created by the feature |
HideParents | Hide the body created by the parent feature |
Highlight | Highlight the body created by the feature |
LogDiagnostic | Log a diagnostic alert for this feature |
MakeCurrentFeature | Make current feature |
MakeSketchExternal | Make the parent sketch external for reuse by other features. |
MakeSketchInternal | Make the parent sketch internal if referenced only by this feature. |
Prints a representation of this object to the system log file. | |
RemoveForEdit | Remove all the feature faces before a NoHistory mode edit. |
RemoveParameters | Remove Local feature parameters in history free mode. |
SetAttribute | Creates or modifies an integer attribute. |
SetBooleanUserAttribute | Creates or modifies a boolean attribute with the option to update or not. |
SetGroupActive | Set a feature group as active group. |
SetName | Sets the custom name of the object. |
SetPdmReferenceAttribute | Sets the value of PDM Reference attribute on the object. |
SetReferenceAttribute | Creates or modifies a string attribute which uses a reference string. |
SetTimeAttribute | Creates or modifies a time attribute. |
SetTimeUserAttribute | Creates or modifies a time attribute with the option to update or not. |
SetUserAttribute | Creates or modifies an attribute with the option to update or not. |
SetUserAttributeLock | Lock or unlock the given attribute. |
ShowBody | Show the body created by the feature. |
ShowDimensions | Show all feature dimensions of a feature. |
ShowParents | Show the body created by the parent feature. |
Suppress | Suppress the feature |
Unhighlight | Unhighlight the body created by the feature |
Unsuppress | Unsuppress the feature |
Enumerations¶
FeatureBooleanType Enumeration | Boolean operation type. |
FeatureDiagnosticType Enumeration | Diagnostic type |
Property Detail¶
AlgorithmVersion¶
-
Feature.
AlgorithmVersion
¶ Returns the algorithm version of the feature
-------------------------------------
Getter Method
Signature
AlgorithmVersion
Returns: Return type: int New in version NX3.0.0.
Deprecated since version NX8.5.0: Algorithm version is for internal use only. There is no replacement for this method.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
ContainerFeature¶
-
Feature.
ContainerFeature
¶ Returns the container feature for this feature.
Will be set to None if this feature is not a contained feature.
-------------------------------------
Getter Method
Signature
ContainerFeature
Returns: Return type: NXOpen.Features.IContainerFeature
New in version NX8.5.0.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
FeatureType¶
-
Feature.
FeatureType
¶ Returns the feature type
-------------------------------------
Getter Method
Signature
FeatureType
Returns: Return type: str New in version NX3.0.0.
License requirements: None.
IsContainedFeature¶
-
Feature.
IsContainedFeature
¶ Returns true if the feature is a contained feature.
If it is a contained feature, use the property
NXOpen.Features.Feature.ContainerFeature()
to get the container feature for this feature.-------------------------------------
Getter Method
Signature
IsContainedFeature
Returns: Return type: bool New in version NX8.5.0.
Deprecated since version NX9.0.0: Use
NXOpen.Features.Feature.ContainerFeature()
and check if it is None instead.License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
IsInternal¶
-
Feature.
IsInternal
¶ Returns true if the feature is internal.
-------------------------------------
Getter Method
Signature
IsInternal
Returns: Return type: bool New in version NX6.0.0.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
IsOccurrence¶
-
Feature.
IsOccurrence
¶ Returns whether this object is an occurrence or not.
-------------------------------------
Getter Method
Signature
IsOccurrence
Returns: This object is an occurrence Return type: bool New in version NX3.0.0.
License requirements: None.
JournalIdentifier¶
-
Feature.
JournalIdentifier
¶ Returns the identifier that would be recorded in a journal for this object.
This may not be the same across different releases of the software.
-------------------------------------
Getter Method
Signature
JournalIdentifier
Returns: Return type: str New in version NX3.0.0.
License requirements: None.
Location¶
-
Feature.
Location
¶ Returns the location of the feature
-------------------------------------
Getter Method
Signature
Location
Returns: Return type: NXOpen.Point3d
New in version NX3.0.0.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR insp_programming (“INSPECTION PROGRAMMING”)
Name¶
-
Feature.
Name
¶ Returns the custom name of the object.
-------------------------------------
Getter Method
Signature
Name
Returns: Return type: str New in version NX3.0.0.
License requirements: None.
OwningComponent¶
-
Feature.
OwningComponent
¶ Returns the owning component, if this object is an occurrence.
-------------------------------------
Getter Method
Signature
OwningComponent
Returns: Return type: NXOpen.Assemblies.Component
New in version NX3.0.0.
License requirements: None.
OwningPart¶
-
Feature.
OwningPart
¶ Returns the owning part of this object
-------------------------------------
Getter Method
Signature
OwningPart
Returns: The owning part of this object or null if it does not have an owner Return type: NXOpen.BasePart
New in version NX3.0.0.
License requirements: None.
Prototype¶
-
Feature.
Prototype
¶ Returns the prototype of this object if it is an occurrence.
-------------------------------------
Getter Method
Signature
Prototype
Returns: The prototype of this object or null if this object is not an occurrence Return type: NXOpen.INXObject
New in version NX3.0.0.
License requirements: None.
Method Detail¶
BreakWaveLink¶
-
Feature.
BreakWaveLink
¶ Break Wave Link Feature
Signature
BreakWaveLink()
Returns: Return type: bool New in version NX11.0.1.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
ChangeBooleanType¶
-
Feature.
ChangeBooleanType
¶ Change Boolean Type
Signature
ChangeBooleanType()
New in version NX9.0.0.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
DeleteClueAlerts¶
-
Feature.
DeleteClueAlerts
¶ Delete all clue alerts from the features
Signature
DeleteClueAlerts()
New in version NX8.0.1.
License requirements: None.
DeleteHintAlerts¶
-
Feature.
DeleteHintAlerts
¶ Delete all clue alerts from the features
Signature
DeleteHintAlerts()
New in version NX8.0.1.
License requirements: None.
DeleteInformationalAlerts¶
-
Feature.
DeleteInformationalAlerts
¶ Delete all informational alerts from the features
Signature
DeleteInformationalAlerts()
New in version NX5.0.0.
License requirements: None.
DeleteWarningAlerts¶
-
Feature.
DeleteWarningAlerts
¶ Delete all warning alerts from the features
Signature
DeleteWarningAlerts()
New in version NX10.0.0.
License requirements: None.
FindObject¶
-
Feature.
FindObject
¶ Finds the
NXOpen.NXObject
with the given identifier as recorded in a journal.An object may not return the same value as its JournalIdentifier in different versions of the software. However newer versions of the software should find the same object when FindObject is passed older versions of its journal identifier. In general, this method should not be used in handwritten code and exists to support record and playback of journals.
An exception will be thrown if no object can be found with the given journal identifier.
Signature
FindObject(journalIdentifier)
Parameters: journalIdentifier (str) – Journal identifier of the object Returns: Return type: NXOpen.INXObject
New in version NX3.0.0.
License requirements: None.
GetAllChildren¶
-
Feature.
GetAllChildren
¶ Returns all immediate child features.
The order in which children are returned is not significant and may change
Signature
GetAllChildren()
Returns: Return type: list of NXOpen.Features.Feature
New in version NX9.0.1.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR insp_programming (“INSPECTION PROGRAMMING”)
GetChildren¶
-
Feature.
GetChildren
¶ Returns the immediate child features.
The order in which children are returned is not significant and may change
Signature
GetChildren()
Returns: Return type: list of NXOpen.Features.Feature
New in version NX3.0.0.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
GetEntities¶
-
Feature.
GetEntities
¶ Returns the entities created by the feature.
The order in which entities are returned is not significant and may change.
Signature
GetEntities()
Returns: Return type: list of NXOpen.NXObject
New in version NX4.0.0.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
GetExpressions¶
-
Feature.
GetExpressions
¶ Returns the expressions created by the feature.
The order in which expressions are returned is not significant and may change
Signature
GetExpressions()
Returns: Return type: list of NXOpen.Expression
New in version NX3.0.0.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
GetFeatureClueHintMessages¶
-
Feature.
GetFeatureClueHintMessages
¶ Returns both clue and hint messages of the feature.
num_clueHint can be NULL. The order in which clue and hint messags are returned is not significant and may change
Signature
GetFeatureClueHintMessages()
Returns: Return type: list of str New in version NX8.0.1.
License requirements: None.
GetFeatureClueMessages¶
-
Feature.
GetFeatureClueMessages
¶ Returns the feature clue messages.
clue_messages can be NULL. The order in which clue messags are returned is not significant and may change
Signature
GetFeatureClueMessages()
Returns: Return type: list of str New in version NX8.0.1.
License requirements: None.
GetFeatureColor¶
GetFeatureErrorMessages¶
-
Feature.
GetFeatureErrorMessages
¶ Returns the feature error messages.
error_messages can be NULL. The order in which error messags are returned is not significant and may change
Signature
GetFeatureErrorMessages()
Returns: Return type: list of str New in version NX5.0.0.
License requirements: None.
GetFeatureHintMessages¶
-
Feature.
GetFeatureHintMessages
¶ Returns the feature hint messages.
hint_messages can be NULL. The order in which hint messags are returned is not significant and may change
Signature
GetFeatureHintMessages()
Returns: Return type: list of str New in version NX8.0.1.
License requirements: None.
GetFeatureInformationalMessages¶
-
Feature.
GetFeatureInformationalMessages
¶ Returns the feature informational messages.
info_messages can be NULL. The order in which informational messags are returned is not significant and may change
Signature
GetFeatureInformationalMessages()
Returns: Return type: list of str New in version NX5.0.0.
License requirements: None.
GetFeatureName¶
-
Feature.
GetFeatureName
¶ Returns the displayed name of the feature.
Signature
GetFeatureName()
Returns: displayed name Return type: str New in version NX6.0.0.
License requirements: None.
GetFeatureWarningMessages¶
-
Feature.
GetFeatureWarningMessages
¶ Returns the feature warning messages.
warning_messages can be NULL. The order in which warning messags are returned is not significant and may change
Signature
GetFeatureWarningMessages()
Returns: Return type: list of str New in version NX5.0.0.
License requirements: None.
GetParents¶
-
Feature.
GetParents
¶ Returns the immediate parent features.
The order in which parents are returned is not significant and may change
Signature
GetParents()
Returns: Return type: list of NXOpen.Features.Feature
New in version NX3.0.0.
License requirements: solid_modeling (“SOLIDS MODELING”)
GetSections¶
-
Feature.
GetSections
¶ Queries a feature for list of its sections.
The order in which sections are returned is not significant and may change
Signature
GetSections()
Returns: Array of sections Return type: list of NXOpen.Section
New in version NX7.5.0.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
HideBody¶
-
Feature.
HideBody
¶ Hide the body created by the feature
Signature
HideBody()
New in version NX3.0.0.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
HideParents¶
-
Feature.
HideParents
¶ Hide the body created by the parent feature
Signature
HideParents()
New in version NX3.0.0.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
Highlight¶
-
Feature.
Highlight
¶ Highlight the body created by the feature
Signature
Highlight()
New in version NX3.0.0.
License requirements: None.
LogDiagnostic¶
-
Feature.
LogDiagnostic
¶ Log a diagnostic alert for this feature
Signature
LogDiagnostic(errorCode, message, diagnosticType)
Parameters: - errorCode (int) –
- message (str) –
- diagnosticType (
NXOpen.Features.FeatureDiagnosticType
) –
New in version NX8.0.0.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
MakeCurrentFeature¶
-
Feature.
MakeCurrentFeature
¶ Make current feature
Signature
MakeCurrentFeature()
New in version NX3.0.0.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
MakeSketchExternal¶
-
Feature.
MakeSketchExternal
¶ Make the parent sketch external for reuse by other features.
Signature
MakeSketchExternal()
New in version NX5.0.1.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
MakeSketchInternal¶
-
Feature.
MakeSketchInternal
¶ Make the parent sketch internal if referenced only by this feature.
Signature
MakeSketchInternal()
New in version NX5.0.1.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
Print¶
-
Feature.
Print
¶ Prints a representation of this object to the system log file.
Signature
Print()
New in version NX3.0.0.
License requirements: None.
RemoveForEdit¶
-
Feature.
RemoveForEdit
¶ Remove all the feature faces before a NoHistory mode edit.
Signature
RemoveForEdit(dependent)
Parameters: dependent (bool) – New in version NX6.0.0.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
RemoveParameters¶
-
Feature.
RemoveParameters
¶ Remove Local feature parameters in history free mode.
Signature
RemoveParameters()
New in version NX7.0.0.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
SetGroupActive¶
-
Feature.
SetGroupActive
¶ Set a feature group as active group.
If input is None, set no feature group active
Signature
SetGroupActive(active)
Parameters: active (bool) – New in version NX7.5.1.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
SetName¶
-
Feature.
SetName
¶ Sets the custom name of the object.
NOTE: This method should not be used to edit a read-only object such as a Mirrored PMI object. If it is, the changes will be overridden when the part is updated.
Signature
SetName(name)
Parameters: name (str) – New in version NX3.0.0.
License requirements: None.
ShowBody¶
-
Feature.
ShowBody
¶ Show the body created by the feature.
The feature curves are to be moved to work layer if the curves are non-selectable when move_curves is true.
Signature
ShowBody(moveCurves)
Parameters: moveCurves (bool) – New in version NX3.0.0.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
ShowDimensions¶
-
Feature.
ShowDimensions
¶ Show all feature dimensions of a feature.
Signature
ShowDimensions()
New in version NX6.0.0.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
ShowParents¶
-
Feature.
ShowParents
¶ Show the body created by the parent feature.
The parent curves of feature are to be moved to work layer if the curves are non-selectable when move_curves is true.
Signature
ShowParents(moveCurves)
Parameters: moveCurves (bool) – New in version NX3.0.0.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)
Suppress¶
-
Feature.
Suppress
¶ Suppress the feature
Signature
Suppress()
New in version NX3.0.0.
License requirements: solid_modeling (“SOLIDS MODELING”) OR cam_base (“CAM BASE”) OR geometric_tol (“GDT”) OR insp_programming (“INSPECTION PROGRAMMING”)