ThroughCurveMeshBuilder Class¶

class NXOpen.Features.ThroughCurveMeshBuilder¶

Bases: NXOpen.Features.FeatureBuilder

Represents a NXOpen.Features.ThroughCurveMesh builder.

Let you create a body from a collection of existing curve outlines (known as strings) running in two different directions.

To create a new instance of this class, use NXOpen.Features.FeatureCollection.CreateThroughCurveMeshBuilder()

Default values.

Property	Value
Construction	Normal
CrossSurfaceRebuildData.RebuildType	None
CurvatureTolerance	0.5
Emphasis	Both
FirstCrossContinuity.ContinuityType	G0
FirstPrimaryContinuity.ContinuityType	G0
IntersectionTolerance	0.02
LastCrossContinuity.ContinuityType	G0
LastPrimaryContinuity.ContinuityType	G0
PositionTolerance	0.0254 (millimeters part), 0.001 (inches part)
PrimarySurfaceRebuildData.RebuildType	None
TangentTolerance	0.5

New in version NX5.0.0.

Properties¶

Property	Description
BodyPreference	Returns or sets the body type options
Construction	Returns or sets the construction options.
CrossCurvesList	Returns the cross curves list which is required.
CrossSurfaceRebuildData	Returns the cross surface rebuild data, `NXOpen.GeometricUtilities.Rebuild`.
CrossTemplateString	Returns the cross template curve.
CurvatureTolerance	Returns or sets the curvature tolerance.
Emphasis	Returns or sets the emphasis options.
FirstCrossContinuity	Returns the first cross continuity, `NXOpen.GeometricUtilities.Continuity`.
FirstPrimaryContinuity	Returns the first primary continuity, `NXOpen.GeometricUtilities.Continuity`.
IntersectionTolerance	Returns or sets the intersection tolerance.
LastCrossContinuity	Returns the last cross continuity, `NXOpen.GeometricUtilities.Continuity`.
LastPrimaryContinuity	Returns the last primary continuity, `NXOpen.GeometricUtilities.Continuity`.
ParentFeatureInternal	Returns or sets whether or not the latest timestamped parent feature of this feature should be made internal
PatchSolutionFlag	Returns or sets the patch solution flag
PatchSurfaceFilename	Returns or sets the patch surface filename
PositionTolerance	Returns or sets the position tolerance.
PrimaryCurvesList	Returns the primary curves list which is required.
PrimarySurfaceRebuildData	Returns the primary surface rebuild data, `NXOpen.GeometricUtilities.Rebuild`.
PrimaryTemplateString	Returns the primary template curve.
Spine	Returns the spine.
SurroundingPatchSurfaceFilename	Returns or sets the surrounding patch surface filename
Tag	Returns the Tag for this object.
TangentTolerance	Returns or sets the tangent tolerance.

Methods¶

Method	Description
Commit	Commits any edits that have been applied to the builder.
CommitFeature	Commits the feature parameters and creates the feature @return
Destroy	Deletes the builder, and cleans up any objects created by the builder.
GetCommittedObjects	For builders that create more than one object, this method returns the objects that are created by commit.
GetFeature	Returns the feature currently being edited by this builder.
GetObject	Returns the object currently being edited by this builder.
HideInternalParentFeatureAfterEdit	Re-suppress an internal parent feature (a slave feature) after it has been edited.
SetParentFeatureInternal	Set the parent features which would be internal or slaves to the feature being created or commited
ShowInternalParentFeatureForEdit	Unsuppress an internal parent feature (a slave feature) so it can be edited.
ShowResults	Updates the model to reflect the result of an edit to the model for all builders that support showing results.
UnsetParentFeatureInternal	Set the internal parent feature of the feature being edited to external
Validate	Validate whether the inputs to the component are sufficient for commit to be called.

Enumerations¶

ThroughCurveMeshBuilderBodyPreferenceTypes Enumeration	This enum represents the body type option.
ThroughCurveMeshBuilderConstructionMethod Enumeration	This enum represents the Construction options.
ThroughCurveMeshBuilderEmphasisType Enumeration	This enum represents the Emphasis options.

Property Detail¶

BodyPreference¶

ThroughCurveMeshBuilder.BodyPreference¶

Returns or sets the body type options

-------------------------------------

Getter Method

Signature BodyPreference()

Returns:
Return type:	`NXOpen.Features.ThroughCurveMeshBuilderBodyPreferenceTypes`

New in version NX7.5.0.

License requirements: None.

-------------------------------------

Setter Method

Signature BodyPreference(bodyPreference)

Parameters:	bodyPreference (`NXOpen.Features.ThroughCurveMeshBuilderBodyPreferenceTypes`) –

New in version NX7.5.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

Construction¶

ThroughCurveMeshBuilder.Construction¶

Returns or sets the construction options.

Use one of three construction options when you create a Through Curve Mesh feature: Normal, Use Spline Points, and Simple.

-------------------------------------

Getter Method

Signature Construction()

Returns:
Return type:	`NXOpen.Features.ThroughCurveMeshBuilderConstructionMethod`

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

-------------------------------------

Setter Method

Signature Construction(construction)

Parameters:	construction (`NXOpen.Features.ThroughCurveMeshBuilderConstructionMethod`) –

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

CrossCurvesList¶

ThroughCurveMeshBuilder.CrossCurvesList¶

Returns the cross curves list which is required.

They should all be roughly parallel and run in approximately one direction. A point could be selected as the first and/or last primary string.

-------------------------------------

Getter Method

Signature CrossCurvesList()

Returns:
Return type:	`NXOpen.SectionList`

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

CrossSurfaceRebuildData¶

ThroughCurveMeshBuilder.CrossSurfaceRebuildData¶

Returns the cross surface rebuild data, NXOpen.GeometricUtilities.Rebuild.

Redefine the degree and knot points of the cross strings to build a surface that joins smoothly with surrounding surfaces. It is only available for the Normal Construction option.

-------------------------------------

Getter Method

Signature CrossSurfaceRebuildData()

Returns:
Return type:	`NXOpen.GeometricUtilities.Rebuild`

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

CrossTemplateString¶

ThroughCurveMeshBuilder.CrossTemplateString¶

Returns the cross template curve.

Control the building of the simple surface in cross curve direction. It is only available when the construction method is simple. If you leave it empty, the system will automatically choose the most complicated one for fitting.

-------------------------------------

Getter Method

Signature CrossTemplateString()

Returns:
Return type:	`NXOpen.Section`

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

CurvatureTolerance¶

ThroughCurveMeshBuilder.CurvatureTolerance¶

Returns or sets the curvature tolerance.

Control the curvature tolerance of the rebuild surface in relation to the input curves.

-------------------------------------

Getter Method

Signature CurvatureTolerance()

Returns:
Return type:	float

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

-------------------------------------

Setter Method

Signature CurvatureTolerance(tolerance)

Parameters:	tolerance (float) –

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

Emphasis¶

ThroughCurveMeshBuilder.Emphasis¶

Returns or sets the emphasis options.

Allow you to tell the system which set of strings will have the most effect on the created surface in both location and shape.

-------------------------------------

Getter Method

Signature Emphasis()

Returns:
Return type:	`NXOpen.Features.ThroughCurveMeshBuilderEmphasisType`

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

-------------------------------------

Setter Method

Signature Emphasis(emphasis)

Parameters:	emphasis (`NXOpen.Features.ThroughCurveMeshBuilderEmphasisType`) –

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

FirstCrossContinuity¶

ThroughCurveMeshBuilder.FirstCrossContinuity¶

Returns the first cross continuity, NXOpen.GeometricUtilities.Continuity.

Define continuity constraint at the first cross sections side. It contains the continuity type and the constraint face.

-------------------------------------

Getter Method

Signature FirstCrossContinuity()

Returns:
Return type:	`NXOpen.GeometricUtilities.Continuity`

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

FirstPrimaryContinuity¶

ThroughCurveMeshBuilder.FirstPrimaryContinuity¶

Returns the first primary continuity, NXOpen.GeometricUtilities.Continuity.

Define continuity constraint at the first primary sections side. It contains the continuity type and the constraint face.

-------------------------------------

Getter Method

Signature FirstPrimaryContinuity()

Returns:
Return type:	`NXOpen.GeometricUtilities.Continuity`

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

IntersectionTolerance¶

ThroughCurveMeshBuilder.IntersectionTolerance¶

Returns or sets the intersection tolerance.

Define how far the primary strings and cross strings can deviate from each other.

-------------------------------------

Getter Method

Signature IntersectionTolerance()

Returns:
Return type:	float

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

-------------------------------------

Setter Method

Signature IntersectionTolerance(tolerance)

Parameters:	tolerance (float) –

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

LastCrossContinuity¶

ThroughCurveMeshBuilder.LastCrossContinuity¶

Returns the last cross continuity, NXOpen.GeometricUtilities.Continuity.

Define continuity constraint at the first cross sections side. It contains the continuity type and the constraint face.

-------------------------------------

Getter Method

Signature LastCrossContinuity()

Returns:
Return type:	`NXOpen.GeometricUtilities.Continuity`

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

LastPrimaryContinuity¶

ThroughCurveMeshBuilder.LastPrimaryContinuity¶

Returns the last primary continuity, NXOpen.GeometricUtilities.Continuity.

Define continuity constraint at the last primary sections side. It contains the continuity type and the constraint face.

-------------------------------------

Getter Method

Signature LastPrimaryContinuity()

Returns:
Return type:	`NXOpen.GeometricUtilities.Continuity`

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

PositionTolerance¶

ThroughCurveMeshBuilder.PositionTolerance¶

Returns or sets the position tolerance.

Control the distance accuracy of the rebuild surface in relation to the input curves.

-------------------------------------

Getter Method

Signature PositionTolerance()

Returns:
Return type:	float

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

-------------------------------------

Setter Method

Signature PositionTolerance(tolerance)

Parameters:	tolerance (float) –

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

PrimaryCurvesList¶

ThroughCurveMeshBuilder.PrimaryCurvesList¶

Returns the primary curves list which is required.

They should all be roughly parallel and run in approximately one direction. A point could be selected as the first and/or last primary string.

-------------------------------------

Getter Method

Signature PrimaryCurvesList()

Returns:
Return type:	`NXOpen.SectionList`

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

PrimarySurfaceRebuildData¶

ThroughCurveMeshBuilder.PrimarySurfaceRebuildData¶

Returns the primary surface rebuild data, NXOpen.GeometricUtilities.Rebuild.

Redefine the degree and knot points of the primary strings to build a surface that joins smoothly with surrounding surfaces. It is only available for the Normal Construction option.

-------------------------------------

Getter Method

Signature PrimarySurfaceRebuildData()

Returns:
Return type:	`NXOpen.GeometricUtilities.Rebuild`

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

PrimaryTemplateString¶

ThroughCurveMeshBuilder.PrimaryTemplateString¶

Returns the primary template curve.

Control the building of the simple surface in primary curve direction. It is only available when the construction method is simple. If you leave it empty, the system will automatically choose the most complicated one for fitting.

-------------------------------------

Getter Method

Signature PrimaryTemplateString()

Returns:
Return type:	`NXOpen.Section`

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

Spine¶

ThroughCurveMeshBuilder.Spine¶

Returns the spine.

Control the parameterization of the cross strings. It is valid only if both the first and last primary strings are planar and this spine string is perpendicular to the first and last primary strings

-------------------------------------

Getter Method

Signature Spine()

Returns:
Return type:	`NXOpen.Section`

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

TangentTolerance¶

ThroughCurveMeshBuilder.TangentTolerance¶

Returns or sets the tangent tolerance.

Control the angle accuracy of the rebuild surface in relation to the input curves.It is expressed in degree.

-------------------------------------

Getter Method

Signature TangentTolerance()

Returns:
Return type:	float

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

-------------------------------------

Setter Method

Signature TangentTolerance(tolerance)

Parameters:	tolerance (float) –

New in version NX5.0.0.

License requirements: features_modeling (“FEATURES MODELING”), nx_freeform_1 (“basic freeform modeling”)

Method Detail¶

Validate¶

ThroughCurveMeshBuilder.Validate¶

Validate whether the inputs to the component are sufficient for commit to be called.

If the component is not in a state to commit then an exception is thrown. For example, if the component requires you to set some property, this method will throw an exception if you haven’t set it. This method throws a not-yet-implemented NXException for some components.

Signature Validate()

Returns:	Was self validation successful
Return type:	bool

New in version NX3.0.1.

License requirements: None.